鈑金表格與展開視圖

1. With an existing sheet metal model in a Part Studio, click (midway along the right side of the window)

   For example:

   

   您可以使用插入符號 (在表格標題旁) 來展開或摺疊表格以利檢視

2. 從面板上方的下拉清單中選擇要編輯的鈑金模型。
3. Click to select rows of the table; click again to deselect.
   • 注意到出現的交叉強調顯示：您在表格中選取的項目會在展平面板與模型中被強調顯示 (反之亦然)。
   • 您可以選擇多個列 (按一下來選取，再按一下來取消選取)。

   在圖形區域中選擇裂口或彎折也同時會在表格中選取 (並捲動至) 相對應的列。

4. 按右鍵來存取鈑金環境選單與指令：在表格中上移/下移，轉換為裂口/彎折。
5. To change a rip joint type, use the dropdown menu on the far right of the table row.

   Note that only 90° joints are able to be styled as Butt joints; non-90° joints must be Edge joints.

6. 若要直接編輯展開型式彎折的 K 係數/彎折裕度/彎折扣除，請連按兩下欄的儲存格，然後輸入一個自訂值。如果值是在適當的範圍之外，系統會以紅色強調顯示儲存格，表示值是錯誤的，並會提供工具提示建議有效的值範圍為何。

7. 連按兩下半徑值來輸入一個新值。

Notes

• As you make edits, the flat pattern updates as well as the sheet metal model in the graphics area. Features are created in the feature list, for example, a Modify joint feature is created when you convert a bend to a rip.

• After a Corner break feature is applied, all model Joints' Type (Rip or Bend) and Style (Edge joint or Butt joint) are no longer editable in the Sheet metal table and flat view. It is recommended to add any Corner break features after finalizing all edits to the Sheet metal model's flanges and joints.

  

  Before Corner break feature applied (top); after Corner break feature applied (bottom)

After converting a bend to a rip (using the table commands, explained above), a Modify joint feature is listed in the Feature list. You are able to right-click and Edit this new joint:

1. Right-click the Modify joint feature in the Feature list, and select Edit, or double-click the Modify joint feature. The Modify joint feature dialog opens:

   

2. Confirm the joint edge you want to modify (the Entity) or select a different one.
3. Select one of the following joint types:
   1. Bend - Creates a curve between the faces/edges with a bend centerline and a radius. Keep the model properties default for the radius, or uncheck that box and specify a new bend radius.
   2. Rip - Create an association between the faces/edges where two sheet metal edges meet. When Rip is selected, select one of the following Rip edge types:
      1. Edge joint - Extends both edges to meet at their inner edges, The minimal gap from the Sheet metal model feature is used to create a gap between the two selections.
      2. Butt joint - Direction 1 - Extends the outer edges of the selected face/edge to each other until they meet. The minimal gap from the Sheet metal model feature is used to create a gap between the two seleections. This option is only available for 90 degree joints.
      3. Butt joint - Direction 2 - Similar to Direction 1, but the handedness of the selected faces/edges is flipped.
   3. Tangent - Creates a tangent edge between the two selected faces/edges if one or more of those edges/faces are circular.
4. Click to accept changes.

The Modify joint feature appears in the Feature list, indicated by this icon .

您可以直接在展開圖樣上繪製草圖，以建立在鈑金製作過程中使用的標記。在鈑金展開圖樣上按右鍵：

1. Select New sketch.

   The sketch dialog opens with the preselected face of the sheet metal flat pattern as the sketch plane.

2. 選擇一個草圖工具並如常建立草圖。
3. 完成草圖繪製後，按一下核取記號。

當匯出鈑金展開圖樣時，您可以選擇是否要在匯出中包括草圖。

擠出展開圖樣草圖

當在展開圖樣草圖上擠出時，會出現精簡版的擠出對話方塊，其中有在鈑金中加入或移除的選項。按一下核取記號來接受變更。

目前無法將在 3D 模型中定義的「擠出」特徵重新用為鈑金展開圖樣中的「擠出」特徵。如果嘗試這樣的操作，會出現下列的警告：

在鈑金展開圖樣的展開視圖上按右鍵，然後選擇「匯出為 DXF/DWG」檔案的選項。

1. 在展開圖樣上按右鍵，然後選擇 [匯出展開圖樣的 DXF/DWG]。

   

2. If an export rule has been set up for exporting to DXF/DWG, a message appears (above in blue). To see the export rules, click View export rules. For more information about export rules, see Custom export rules.
3. 指定檔案名稱。
4. 選擇一個格式：DWG 或 DXF。
5. 選擇一個版本。
6. 選擇一個範圍：
   • 僅限單一展平型式零件 - 僅匯出這個展平型式零件。
   • 目前模型中所有展平型式的零件 - 匯出由特定鈑金模型特徵建立所有零件的展平型式 (例如，由單一鈑金模型特徵建立的多個零件)。
   • Part Studio 中所有展平型式的零件 - 匯出使用中 Part Studio 內所有鈑金零件的展平型式。
7. 選擇一個下載選項：
8. Select the parameters for your export:
   • 將樣條匯出為聚合線。
   • 將 z-高度設定為零，法線設定為正的。
   • 包含或隱藏彎折中心線。
   • 包含或隱藏彎折相切線。
   • 包含或隱藏可見草圖 - 選擇這個選項來包括在展開圖樣上建立的所有草圖。
   • 將模型的展開圖樣壓縮為個別的檔案。
9. 按一下匯出。

當鈑金模型啟用時 (在建立或編輯鈑金的過程中)，其他可用的工具包括：

• 凸緣 - 為每條所選的邊線建立牆面，使用彎折來連接所選的邊線。
• 摺邊 - 在現有的鈑金零件上為所選取的邊線/面建立摺邊。
• 薄板頁 - 將一個薄板頁加入至鈑金凸緣中。
• Bend - Bend a sheet metal model along a reference line, with additional bend control options.
• 製作接合 - 將兩個牆面的相交處轉換為一個接合特徵，可以是一個彎折 (以圓柱幾何接合牆面)，或是一個裂口 (兩個牆之間的小間隙)。
• 轉角 - 修改轉角類型與止裂比例。
• 彎折止裂 - 修改彎折止裂 (在彎折結束與自由邊線交會處做出的小切除)、深度與止裂寬度。
• Modify joint - Make changes to an existing joint, such as converting a bend to a rip. Currently available through the flat view table.
• Corner break - Break the corner on existing sheet metal parts by applying a fillet or chamfer. Select a corner edge or vertex and specify corner break type and distance. It is recommended to use this feature after all flanges and joints of the Sheet metal model are finalized.
• Sheet metal table and flat view - Open and close the Rip/Bend tables and the visualization of the sheet metal model flat pattern. Use this table to convert rips to bends and vice versa.
• 完成鈑金模型 - 關閉 (停用) 鈑金模型；建立特徵清單中的特徵。