鑽孔
Create simple, countersink, and counterbore holes at sketch points, circle centers, and Mate connectors.
鑽孔：桌面版
影片範例
影片字幕
The Hole feature creates simple, counterbore, and countersink holes based on sketch points or Mate connectors.
Start a new Hole. Click a measurement, either Inch or Metric. Click a style, either Simple, Counterbore, or Countersink. The sketch points to place holes field defines the hole placement with either sketch points or Mate connectors. When using Mate connectors for placement, the holes do not have to be on the same plane.
Create a sketch beforehand to define the placement of each hole or show existing sketches and select individual points.
The Merge scope field defines the parts through which the holes are allowed to cut.
Select a Hole type from the dropdown. Hole types include Drilled, Clearance, Tapped, and PEM®. PEM® is only available for a simple hole style. Hole type controls expand, allowing users to define precision and tolerance values. These values propagate to the Hole table and Hole/thread callouts.
Select a Start plane to define where the hole is created. Start from part is useful when the sketch plane containing the Sketch points to place holes are above the part geometry, but the hole should start at the face of the part. Start from sketch plane determines whether the hole starts at the sketch plane or the first face. Start from selected plane provides the Hole start plane or mate connector field to define the start plane.
Select a Termination for the hole. Four options are available: Blind, Up to next, Up to entity, and Through all. To change the direction of the hole, click the opposite direction toggle. Holes created with the Hole feature can only go through a part in one direction from the sketch plane.
Select a Tip angle style from different angles of 118 and 135 degrees, flat, or custom.
Any Part Studio with Hole features has a Hole table. Hovering over a row in this table cross-highlights the corresponding holes in the graphics area. Selecting a hole from the graphics area cross-highlights the associated row inside the table. This table displays an automatically assigned tag to each hole, along with hole size and quantity. Quantity includes any patterned instances of the hole. Expand the overflow menu to copy the table.
Add the Hole table to a drawing sheet from the Drawing toolbar. The Hole feature, in conjunction with the Hole table, provides a quick way to create and manage holes in a simple-to-use interface within the Part Studio.
步驟
- Create a sketch with sketch points, then click the Hole feature icon (
) on the Features toolbar.
-
Select a measurement, either Inch or Metric.
- Select a hole style:
- Simple - A uniform-diameter drilled hole.
- Counterbore - A cylindrical flat-bottomed drilled hole that enlarges another coaxial drilled hole.
- Countersink - A drilled hole with a conical relief at the top.
- Select points in the sketch (including corners of geometry, line ends, spline points, circle centers, etc.) where the hole centers are to be placed.
- You can box-select multiple points.
- You can click the Mate connector icon (
) to select or create implicit Mate connectors as points instead of sketch points: 
Once a Mate connector is selected, click the Mate connector icon (
) to open a dialog to edit the Mate connector: 
- Alternatively, click on a sketch and to automatically select all the points on the sketch, not including those used as construction geometry.
- 在對話方塊中已選擇了合併範圍欄位的情況下，選擇包含鑽孔的零件。
- Select from the following Hole types and hole type specifications that suit your needs. Not all Hole type specifications are available for all Hole types, and depend upon your selections:
- Drilled - Creates a drilled hole.
- Drill size - Select a Drill size from the dropdown list.
- Clearance - Creates a clearance hole.
- Size - Select a Clearance size from the dropdown list.
- Fastener fit - Select from Close, Free, Close (ASME), Normal (ASME), Loose (ASME)
- Tapped - Creates a tapped hole.
- Tap type - Select either Straight tap or Tapered pipe tap.
- Size - Select a tapped hole size from the dropdown list.
- Threads/inch - Select the number of threads per inch (tpi) setting from the dropdown list.
- Fastener fit - Available only for Straight tap Tap type when 2 or more parts are selected in the Merge scope field. Select from None, Close, Free, Close (ASME), Normal (ASME), Loose (ASME).
- Thread class - Optionally, select the checkbox to toggle Thread class on or off. When toggled on, the appropriate Inch or Metric classes will be available in the dropdown.
- PEM® - PennEngineering® fasteners. This option is not available for counterbored or countersunk holes.
- Fastener - Select from Self-clinching nuts, Self-clinching standoffs, Self-clinghing studs & pins
- Fastener type - Select from S™/SS™/CLS™/CLSS™/SP™ nuts, CLA™ free running locknuts, S-RT™ Free-running locknuts, SL™ TRI-DENT® Prevailing torque locknuts, Self-clinching nuts, H™ Nuts/HNL™ Prevailing torque locknuts, SH™ Hard panel nuts, SMPS™/SMPP™ Nuts.
- Size - Select a tapped hole size from the dropdown list.
- Fastener fit - Clearance.
- Drilled - Creates a drilled hole.
- Enter the diameter tolerance controls for the hole:
- Diameter - Enter a diameter value for the hole.
- Precision - Select a precision for the hole, either Workspace precision or another precision value from the dropdown list.
- Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, Max, Fit, Fit with tolerance, Fit (tolerance only).
- Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
- Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
- Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
- Standard - Available for the Fit Tolerance type. Select the ANSI or ISO standard from the dropdown list.
- Fit type - Available for the Fit Tolerance type. Select User defined, Clearance, Transition, or Interference from the dropdown list.
- Hole class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Select H5, H6, H7, H8, H9, H10, H11 from the dropdown list.
- Shaft class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types when the ISO Standard is selected. Select a Shaft class from the dropdown list.
- Select the Start plane for the hole:
- Start from part - the hole begins from the part face.
- Start from sketch plane - The hole begins from the sketch plane.
- Start from selected plane - The hole begins from a selected plane.
- Hole start plane or Mate connector - Select the entity (plane or Mate connector) from which the hole begins.
這些選項可讓您控制當於不同高度開始鑽孔時，深度會在零件上的相同位置上結束。例如，鑽孔的所有草圖點都在同一平面上：
對於有 1 英吋深度的埋頭孔，當鑽孔不是從草圖平面開始時，較短的鑽孔會僅包含埋頭的部分，而較深的鑽孔則會包含埋頭與螺栓：
但當鑽孔是從草圖平面開始時，則會先放置螺栓，埋頭的部分則會被縮短：
同樣的情形也適用於沉頭孔。簡易直孔僅會調整深度。
- Select a Termination (end) condition. For all termination end conditions, click the Opposite direction arrow (
) to flip the hole direction. - Blind - The hole ends at a specified depth in the selected part.
- Depth - Enter the depth value for the hole, inclusive of the counterbore or countersink depth.
- Precision - Select a precision for the hole depth, either Workspace precision or another precision value from the dropdown list.
- Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, and Max.
- Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
- Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
- Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
- Counterbore diameter - For counterbore holes, enter the diameter value for the hole tip, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Counterbore depth - For counterbore holes, enter the depth value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Countersink diameter - For countersink holes, enter the diameter value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Countersink angle - For countersink holes, enter the angle value of the hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Tapped depth - For tapped holes, the full thread depth of a tapped hole, in document units (or specify other units). Precision and Tolerance type controls have the same options as listed above, under the Depth tolerance controls.
- Tap clearance - For blind tapped holes, the number of thread pitch lengths between the bottom of the Tapped depth and bottom of the hole.
Zero and negative values are accepted for the lower and upper bounds when Limits or Deviation tolerance type is selected. An error occurs if the computed lower bound is greater than the computed upper bound. The computed upper and lower bounds can be equal.
- Depth - Enter the depth value for the hole, inclusive of the counterbore or countersink depth.
- Up to next - Up to the next face or faces encountered.
- Offset from tip - Check to enter an offset distance value from the hole tip. Click the Opposite direction arrow () to flip the offset.
- Depth - Multiple.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Offset from tip - Check to enter an offset distance value from the hole tip. Click the Opposite direction arrow (
- Up to entity - Up to a selected entity or Mate connector.
- Up to entity or Mate connector - Select the entity (for example, a face or plane) or Mate connector ().
- Offset from tip - Check to enter an offset distance value from the hole tip. Click the Opposite direction arrow () to flip the offset.
- Depth - Multiple.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Up to entity or Mate connector - Select the entity (for example, a face or plane) or Mate connector (
- Through all - Completely through the part(s) selected in the Merge scope.
- Tap through all - For tapped holes, keep checked to create thread for the full length of the hole. Uncheck to specify:
- Tapped depth - Enter a custom thread depth.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Tap through all - For tapped holes, keep checked to create thread for the full length of the hole. Uncheck to specify:
- Blind - The hole ends at a specified depth in the selected part.
- Select the Tip angle style for the hole. Options are 118 degrees, 135 degrees, Flat, or Custom to customize your own.
- Tip angle - For custom holes, enter a Tip angle value.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- The name of the Hole feature automatically updates to reflect the hole's settings.
- To rename the hole, hover over the Name field in the Hole dialog, and click the Pencil icon that appears. Type a new name, and then press enter.
- To change a hole name back to the auto-generated default, hover over the Name field in the Hole dialog, click the Pencil icon, delete everything in the Name field, and then press enter.
- Click the checkmark icon (
) to create the hole.
簡易
一個相同直徑的鑽孔：
貫穿鈑金
可以在啟用的鈑金特徵上建立鑽孔，也可以將埋頭孔或沉頭孔加入至鈑金中，如下所示：
The calculation of the hole can impact multiple sheet metal parts based on the merge scope of the hole feature. In the example below, 2 sheet metal parts are created with flanges that are touching. When a countersink hole is added to the model, and both parts are included in the hole's Merge scope, the result is a countersunk hole through both parts:
螺孔深度的重新調整
當使用「成形至下一幾何」或「成形至圖元」終止形態時，如果螺孔深度的輸入值大於最小的經計算鑽孔深度，則會重新調整螺孔深度，並會顯示下列的訊息：
-
如果經計算鑽孔深度大於輸入的螺孔深度，則不會重新調整螺孔深度。
-
如果經計算鑽孔深度小於輸入的螺孔深度，則會將螺孔深度值調整為經計算鑽孔深度值。
對於完全貫穿的鑽孔，在工程圖中的鑽孔/螺紋標註上對經計算鑽孔深度與螺孔深度值都會顯示 THRU：
提示
- 會清除在草圖平面上的點與鑽孔之間的所有材料：
- 如果您改變草圖，會重新計算鑽孔特徵。
- 這個特徵包含會邏輯性推理來決定鑽孔的較佳開始深度，這對彎曲或不規則的曲面是相當有用的。此為系統預設。如果您要在草圖平面上開始鑽孔，請核取該方塊 (會有效地關閉開始深度的邏輯推理)。核取該方塊可讓您建立重疊的鑽孔。
- 在鑽孔特徵碰撞抵觸或鑽孔沒有完全位在目標零件的情況下，會在相對於草圖平面的 0 深度進行鑽孔。
-
如果標準中不提供埋頭孔、沉頭孔或螺絲鑽直徑，在值超出範圍的情況下，將會被重設。
-
With two or more parts selected, and Tapped > Fastener fit set to something other than None, the initial holes are clearance holes and the final hole is tapped (this method replaces the deprecated Blind in last option).
鑽孔：iOS
Create simple, countersink, and counterbore holes at sketch points, circle centers, and Mate connectors.
步驟
- Tap the Hole tool ().
-
Select a measurement, either Inch or Metric.
- Select a hole style:
- Simple - A uniform-diameter drilled hole.
- Counterbore - A cylindrical flat-bottomed drilled hole that enlarges another coaxial drilled hole.
- Countersink - A drilled hole with a conical relief at the top.
- Select points in the sketch (including corners of geometry, line ends, spline points, circle centers, etc.) where the hole centers are to be placed.
- You can tap the Mate connector icon () to select or create implicit Mate connectors as points instead of sketch points.
- You can tap the Mate connector icon (
- Tap Merge scope to select the part(s) to contain the holes.
- Tap Hole type and select a Hole type, and then the specifications that suit your needs. Not all Hole type specifications are available for all Hole types.
- Drilled - Creates a drilled hole.
- Drill size - Select a Drill size from the dropdown list.
- Clearance - Creates a clearance hole.
- Size - Select a Clearance size from the dropdown list.
- Fastener fit - Select from Close, Free, Close (ASME), Normal (ASME), Loose (ASME)
- Tapped - Creates a tapped hole.
- Tap type - Select either Straight tap or Tapered pipe tap.
- Size - Select a tapped hole size from the dropdown list.
- Threads/inch - Select the number of threads per inch (tpi) setting from the dropdown list.
- Class - Depends on size selection. Select from 1B, 2B, or 3B.
- Fastener fit - Available only for Straight tap Tap type when 2 or more parts are selected in the Merge scope field. Select from None, Close, Free, Close (ASME), Normal (ASME), Loose (ASME).
- PEM® - PennEngineering® fasteners. This option is not available for counterbored or countersunk holes.
- Fastener - Select from Self-clinching nuts, Self-clinching standoffs, Self-clinghing studs & pins
- Fastener type - Select from S™/SS™/CLS™/CLSS™/SP™ nuts, CLA™ free running locknuts, S-RT™ Free-running locknuts, SL™ TRI-DENT® Prevailing torque locknuts, Self-clinching nuts, H™ Nuts/HNL™ Prevailing torque locknuts, SH™ Hard panel nuts, SMPS™/SMPP™ Nuts.
- Size - Select a tapped hole size from the dropdown list.
- Fastener fit - Clearance.
- Drilled - Creates a drilled hole.
- Enter the diameter tolerance controls for the hole:
- Diameter - Enter a diameter value for the hole.
- Precision - Select a precision for the hole, either Workspace precision or another precision value from the dropdown list.
- Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, Max, Fit, Fit with tolerance, Fit (tolerance only).
- Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
- Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
- Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
- Standard - Available for the Fit Tolerance type. Select the ANSI or ISO standard from the dropdown list.
- Fit type - Available for the Fit Tolerance type. Select User defined, Clearance, Transition, or Interference from the dropdown list.
- Hole class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Select H5, H6, H7, H8, H9, H10, H11 from the dropdown list.
- Shaft class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types when the ISO Standard is selected. Select a Shaft class from the dropdown list.
- Select the Start plane for the hole:
- Start from part - the hole begins from the part face.
- Start from sketch plane - The hole begins from the sketch plane.
- Start from selected plane - The hole begins from a selected plane.
- Hole start plane or Mate connector - Select the entity (plane or Mate connector) from which the hole begins.
這些選項可讓您控制當於不同高度開始鑽孔時，深度會在零件上的相同位置上結束。例如，鑽孔的所有草圖點都在同一平面上：
對於有 1 英吋深度的埋頭孔，當鑽孔不是從草圖平面開始時，較短的鑽孔會僅包含埋頭的部分，而較深的鑽孔則會包含埋頭與螺栓：
但當鑽孔是從草圖平面開始時，則會先放置螺栓，埋頭的部分則會被縮短：
同樣的情形也適用於沉頭孔。簡易直孔僅會調整深度。
- Select a Termination (end) condition. For all termination end conditions, tap the Opposite direction toggle to flip the hole direction.
- Blind - The hole ends at a specified depth in the selected part.
- Depth - Enter the depth value for the hole, inclusive of the counterbore or countersink depth.
- Precision - Select a precision for the hole depth, either Workspace precision or another precision value from the dropdown list.
- Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, and Max.
- Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
- Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
- Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
- Counterbore diameter - For counterbore holes, enter the diameter value for the hole tip, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Counterbore depth - For counterbore holes, enter the depth value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Countersink diameter - For countersink holes, enter the diameter value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Countersink angle - For countersink holes, enter the angle value of the hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Tapped depth - For tapped holes, the full thread depth of a tapped hole, in document units (or specify other units). Precision and Tolerance type controls have the same options as listed above, under the Depth tolerance controls.
- Tap clearance - For blind tapped holes, the number of thread pitch lengths between the bottom of the Tapped depth and bottom of the hole.
Zero and negative values are accepted for the lower and upper bounds when Limits or Deviation tolerance type is selected. An error occurs if the computed lower bound is greater than the computed upper bound. The computed upper and lower bounds can be equal.
- Depth - Enter the depth value for the hole, inclusive of the counterbore or countersink depth.
- Up to next - Up to the next face or faces encountered.
- Offset from tip - Tap the toggle to enter an offset distance value from the hole tip. Tap the Opposite direction toggle to flip the offset.
- Depth - Multiple.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Up to entity - Up to a selected entity or Mate connector.
- Up to entity or Mate connector - Select the entity (for example, a face or plane) or Mate connector ().
- Offset from tip - Tap the toggle to enter an offset distance value from the hole tip. Tap the Opposite direction toggle to flip the offset.
- Depth - Multiple.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Up to entity or Mate connector - Select the entity (for example, a face or plane) or Mate connector (
- Through all - Completely through the part(s) selected in the Merge scope.
- Tap through all - For tapped holes, Keep the toggle on to create thread for the full length of the hole. Tap the toggle off to specify:
- Tapped depth - Enter a custom thread depth.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Tap through all - For tapped holes, Keep the toggle on to create thread for the full length of the hole. Tap the toggle off to specify:
- Blind - The hole ends at a specified depth in the selected part.
- Select the Tip angle style for the hole. Options are 118 degrees, 135 degrees, Flat, or Custom to customize your own.
- Tip angle - For custom holes, enter a Tip angle value.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Tap the checkmark to create the hole.
簡易
一個相同直徑的鑽孔
終止形態的範例
給定深度
在所選零件上鑽至指定的深度
This shows a simple hole with Blind selected as the termination condition and a depth set to 10 inches. Thus, the hole is created 10 inches through the plates, and only passes through the top two plates.
成形至下一幾何
成形至在指定方向上所碰到的下一個面。
選擇「成形至下一幾何」為終止形態的簡易直孔：
成形至圖元
成形至在指定方向上所碰到的下一個 (或選取的) 圖元。
選擇「成形至圖元」為終止形態的簡易直孔，深藍色的零件是所選的圖元：
完全貫穿
完全貫穿所選的一或多個零件。
This shows a simple hole with Through set as the termination condition and all four plates selected. Thus, the hole is through all four plates.
提示
- 會清除在草圖平面上的點與鑽孔之間的所有材料。
- 如果您改變草圖，會重新計算鑽孔特徵。
- This feature includes logic to determine a good starting depth for the hole, useful for curved or irregular surfaces. This is the default. If you want the hole start to be located at the sketch plane, toggle on Start from sketch plane (effectively turning off the starting depth logic). Toggling this option on also allows you to create overlapping holes.
- 在鑽孔特徵碰撞抵觸或鑽孔沒有完全位在目標零件的情況下，會在相對於草圖平面的 0 深度進行鑽孔。
- 如果標準中不提供埋頭孔、沉頭孔或螺絲鑽直徑，在值超出範圍的情況下，將會重設值。
- With two or more parts selected, and Tapped > Fastener fit set to something other than None, the initial holes are clearance holes and the final hole is tapped (this method replaces the deprecated Blind in last option).
鑽孔：Android
Create simple, countersink, and counterbore holes at sketch points, circle centers, and Mate connectors.
步驟
- Tap the Hole tool ().
-
Select a measurement unit, either Inch or Metric.
- Select a hole style:
- Simple - A uniform-diameter drilled hole.
- Counterbore - A cylindrical flat-bottomed drilled hole that enlarges another coaxial drilled hole.
- Countersink - A drilled hole with a conical relief at the top.
- Select points in the sketch (including corners of geometry, line ends, spline points, circle centers, etc.) where the hole centers are to be placed.
- You can tap the Mate connector icon () to select or create implicit Mate connectors as points instead of sketch points.
- You can tap the Mate connector icon (
- Tap Merge scope to select the part(s) to contain the holes.
- Tap Hole type and select a Hole type, and then the specifications that suit your needs. Not all Hole type specifications are available for all Hole types.
- Drilled - Creates a drilled hole.
- Drill size - Select a Drill size from the dropdown list.
- Clearance - Creates a clearance hole.
- Size - Select a Clearance size from the dropdown list.
- Fastener fit - Select from Close, Free, Close (ASME), Normal (ASME), Loose (ASME)
- Tapped - Creates a tapped hole.
- Tap type - Select either Straight tap or Tapered pipe tap.
- Size - Select a tapped hole size from the dropdown list.
- Threads/inch - Select the number of threads per inch (tpi) setting from the dropdown list.
- Class - Depends on size selection. Select from 1B, 2B, or 3B.
- Fastener fit - Available only for Straight tap Tap type when 2 or more parts are selected in the Merge scope field. Select from None, Close, Free, Close (ASME), Normal (ASME), Loose (ASME).
- PEM® - PennEngineering® fasteners. This option is not available for counterbored or countersunk holes.
- Fastener - Select from Self-clinching nuts, Self-clinching standoffs, Self-clinghing studs & pins
- Fastener type - Select from S™/SS™/CLS™/CLSS™/SP™ nuts, CLA™ free running locknuts, S-RT™ Free-running locknuts, SL™ TRI-DENT® Prevailing torque locknuts, Self-clinching nuts, H™ Nuts/HNL™ Prevailing torque locknuts, SH™ Hard panel nuts, SMPS™/SMPP™ Nuts.
- Size - Select a tapped hole size from the dropdown list.
- Fastener fit - Clearance.
- Drilled - Creates a drilled hole.
- Enter the diameter tolerance controls for the hole:
- Diameter - Enter a diameter value for the hole.
- Precision - Select a precision for the hole, either Workspace precision or another precision value from the dropdown list.
- Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, Max, Fit, Fit with tolerance, Fit (tolerance only).
- Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
- Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
- Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
- Standard - Available for the Fit Tolerance type. Select the ANSI or ISO standard from the dropdown list.
- Fit type - Available for the Fit Tolerance type. Select User defined, Clearance, Transition, or Interference from the dropdown list.
- Hole class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Select H5, H6, H7, H8, H9, H10, H11 from the dropdown list.
- Shaft class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types when the ISO Standard is selected. Select a Shaft class from the dropdown list.
- Select the Start plane for the hole:
- Start from part - the hole begins from the part face.
- Start from sketch plane - The hole begins from the sketch plane.
- Start from selected plane - The hole begins from a selected plane.
- Hole start plane or Mate connector - Select the entity (plane or Mate connector) from which the hole begins.
這些選項可讓您控制當於不同高度開始鑽孔時，深度會在零件上的相同位置上結束。例如，鑽孔的所有草圖點都在同一平面上：
對於有 1 英吋深度的埋頭孔，當鑽孔不是從草圖平面開始時，較短的鑽孔會僅包含埋頭的部分，而較深的鑽孔則會包含埋頭與螺栓：
但當鑽孔是從草圖平面開始時，則會先放置螺栓，埋頭的部分則會被縮短：
同樣的情形也適用於沉頭孔。簡易直孔僅會調整深度。
- Select a Termination (end) condition. For all termination end conditions, tap the Opposite direction toggle to flip the hole direction.
- Blind - The hole ends at a specified depth in the selected part.
- Depth - Enter the depth value for the hole, inclusive of the counterbore or countersink depth.
- Precision - Select a precision for the hole depth, either Workspace precision or another precision value from the dropdown list.
- Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, and Max.
- Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
- Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
- Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
- Counterbore diameter - For counterbore holes, enter the diameter value for the hole tip, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Counterbore depth - For counterbore holes, enter the depth value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Countersink diameter - For countersink holes, enter the diameter value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Countersink angle - For countersink holes, enter the angle value of the hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
- Tapped depth - For tapped holes, the full thread depth of a tapped hole, in document units (or specify other units). Precision and Tolerance type controls have the same options as listed above, under the Depth tolerance controls.
- Tap clearance - For blind tapped holes, the number of thread pitch lengths between the bottom of the Tapped depth and bottom of the hole.
Zero and negative values are accepted for the lower and upper bounds when Limits or Deviation tolerance type is selected. An error occurs if the computed lower bound is greater than the computed upper bound. The computed upper and lower bounds can be equal.
- Depth - Enter the depth value for the hole, inclusive of the counterbore or countersink depth.
- Up to next - Up to the next face or faces encountered.
- Offset from tip - Tap the toggle to enter an offset distance value from the hole tip. Tap the Opposite direction toggle to flip the offset.
- Depth - Multiple.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Up to entity - Up to a selected entity or Mate connector.
- Up to entity or Mate connector - Select the entity (for example, a face or plane) or Mate connector ().
- Offset from tip - Tap the toggle to enter an offset distance value from the hole tip. Tap the Opposite direction toggle to flip the offset.
- Depth - Multiple.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Up to entity or Mate connector - Select the entity (for example, a face or plane) or Mate connector (
- Through all - Completely through the part(s) selected in the Merge scope.
- Tap through all - For tapped holes, Keep the toggle on to create thread for the full length of the hole. Tap the toggle off to specify:
- Tapped depth - Enter a custom thread depth.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- Tap through all - For tapped holes, Keep the toggle on to create thread for the full length of the hole. Tap the toggle off to specify:
- Blind - The hole ends at a specified depth in the selected part.
- Select the Tip angle style for the hole. Options are 118 degrees, 135 degrees, Flat, or Custom to customize your own.
- Tip angle - For custom holes, enter a Tip angle value.
- Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
- 輕觸核取記號。
簡易
一個相同直徑的鑽孔
終止形態的範例
給定深度
在所選零件上鑽至指定的深度
This shows a simple hole with Blind selected as the termination condition and a depth set to 10 inches. Thus, the hole is created 10 inches through the plates, and only passes through the top two plates.
成形至下一幾何
成形至在指定方向上所碰到的下一個面。
選擇「成形至下一幾何」為終止形態的簡易直孔：
成形至圖元
成形至在指定方向上所碰到的下一個 (或選取的) 圖元。
選擇「成形至圖元」為終止形態的簡易直孔，深藍色的零件是所選的圖元：
完全貫穿
完全貫穿所選的一或多個零件。
This shows a simple hole with Through set as the termination condition and all four plates selected. Thus, the hole is through all four plates.
提示
- 會清除在草圖平面上的點與鑽孔之間的所有材料。
- 如果您改變草圖，會重新計算鑽孔特徵。
- This feature includes logic to determine a good starting depth for the hole, useful for curved or irregular surfaces. This is the default. If you want the hole start to be located at the sketch plane, toggle on Start from sketch plane (effectively turning off the starting depth logic). Toggling this option on also allows you to create overlapping holes.
- 在鑽孔特徵碰撞抵觸或鑽孔沒有完全位在目標零件的情況下，會在相對於草圖平面的 0 深度進行鑽孔。
- 如果標準中不提供埋頭孔、沉頭孔或螺絲鑽直徑，在值超出範圍的情況下，將會重設值。
- With two or more parts selected, and Tapped > Fastener fit set to something other than None, the initial holes are clearance holes and the final hole is tapped (this method replaces the deprecated Blind in last option).