在工程圖中按右鍵然後選擇 [工程圖屬性]。
The icon to access the Drawing Properties panel is located on the right side of the drawings area. Click the icon to open the panel, click again to close the panel. Use these settings to define the defaults for your drawing. Individual drawing entities may be changed separately, but these settings apply to all entities in a drawing as a default. Once you have your drawing properties set to your satisfaction, you can save the drawing and its settings as a template. For information on creating a template, see Custom Drawing Templates.
開啟屬性面板
下方的圖例顯示這個圖示，就位在工程圖視窗右側的中下方，以紅色輪廓線框出：
「屬性」面板有多個分頁，分別說明如下。
單位與精度
按一下「工程圖屬性」面板上方標示為 [單位與精度] 的第一個圖示來編輯工程圖的單位與精度。
主要
定義工程圖的預設主要單位。可以編輯下列項目的格式：
- Units - Default units for the drawing. Choose between: Inches, Inches fractional, Millimeters, and Feet and inches.
- Decimal separator - Default character to use a decimal separator. Choose between: Comma and Period.
- Precision - The precision of all numbers except those listed in the Properties panel. Choose between: Zero and up to 6 decimal places, or between 0 and 1/256 for fractional numbers.
- Tolerance precision - The precision of geometric tolerances. Choose between: Zero and up to 6 decimal places, or between 0 and 1/256 for fractional numbers.
- Angular precision - The precision of angular measurements. Choose between: Zero and up to 6 decimal places.
使用預設屬性的原始工程圖 (上圖)，將小數分隔符號改設為「小數」(下圖)
- Angular tolerance precision - The precision of the tolerance for an angle. Choose between: Zero and up to 6 decimal places.
雙重
指定是否要在工程圖中顯示雙重尺寸和/或雙重單位。您可以參考視圖指定尺寸的位置，也可以指定單位類型、小數位數的精度與公差精度。
- Check Show dual dimensions to display all drawings dimensions in the default document units as well as a second, specified unit. Specify where to display the second dimension, either on top of, or on the bottom of the default units:
- Check Show dual unit to display the units of the dual dimension; otherwise, just the dimension is shown, without the unit of measurement.
- Dimension location - Specify where to place the dual dimension: on the top or bottom of the initial dimension
- Hole callout location - Select where to place the hole callout dual dimension: top, bottom, left or right of the initial dimension.
- Units - Specify the units for the dual dimension: this list will contain all units of measure except the units specified for the initial dimension label.
- Precision - The precision of the dual dimension. Choose between: Zero and up to 6 decimal places, or between 0 and 1/256 for fractional numbers.
- Tolerance precision - The precision of geometric tolerances. Choose between: Zero and up to 6 decimal places, or between 0 and 1/256 for fractional numbers.
Drawing with Show dual dimensions selected, Show dual unit selected with Units set to 'Inches', and Precision set to '0.12' (two decimal places)
前置與尾隨零
使用這些設定來建立長度前置與尾隨零的格式。
- Length leading zeros - Select to include leading zeros on lengths.
- Length trailing zeros - Select to include trailing zeros on lengths.
- Length tolerance leading zeros - Select to include leading zeros for tolerances.
- Length tolerance trailing zeros - Select to include trailing zeros for tolerances.
Drawing with Length trailing zeros set on
尺寸![[尺寸] 圖示](Resources/Images/icons/dimensiontooliconLG.png){kind=icon}
若要存取「尺寸」功能表，按一下「工程圖屬性」面板圖示列中的第二個圖示。
使用這個分頁來編輯工程圖的字型、文字高度、色彩、文字對齊、文字間隙、幾何間距等。按一下右側功能表的下拉式功能表箭頭並選擇一個選項來變更各個選項。
- Font - Select the font of choice for dimension text.
- Text height - Select the size of choice for dimension text.
- Color - To edit colors for any drawing entity, click the color block in the Drawing properties panel to access the color dialog:
- Select Palette to choose a color or enter a hex or RGB codes. Use the Mixer panel to drag to a general color area and then enter a specific hex or RGB code.
On either the Palette or Mixer panels you can click the plus sign under Custom colors to save the currently specified color value as a custom color for later use.
- Arrowhead length - Change the size of arrowheads for dimensions. Arrowhead length can be any value between 0.004 inches and 393.7 inches.
- Arrowhead type - Choose from no arrowhead, filled arrowhead, unfilled arrowhead, open arrowhead, oblique marks, or filled dot.
Drawing with the Color of dimensions set to red, the Font changed to APMONO, the Text height increased to 4.5, and the Arrowhead length set to 4.5000. Second image illustrates 'Oblique' selected as the Arrowhead type.
- Text justification - Change the justification of all the Note and Hole/thread callout text in the drawing. Choose from Left, Center, Right, or Auto alignment.
- Underline overridden dimensions - Uncheck this box to remove the underline format from all currently overridden dimensions.
間隙與延伸
使用這個分頁來編輯您工程圖的文字對齊＿文字間距、幾何間距、超出尺寸界線，並將所有轉折尺寸的角度鎖定為 45 度：
- Text alignment - Specify whether to align the dimension text with either the dimension line, or align it horizontally along the bottom edge of the drawing sheet.
- Text gap - Set the measurements of the text gap in the drawing.
- Geometry gap - Set the measurements of the geometry gap in the drawing.
- 超出尺寸界線- 設定尺寸界線延伸超出文字的距離。
- Lock the angle of all jogged dimensions to 45 degrees - Check this box to lock the angle of all jogged dimensions in the drawing to 45 degrees.
Drawing with Text alignment set to Horizontal, and Text gap and Geometry gap set to 0.75, and Extension past line increased to 1.5
倒角尺寸
For information on using the tool, see Dimensions, Chamfer dimension.
使用這些屬性來對工程圖中的倒角尺寸進行變化。您可以指定：
- 45 度樣式 - 選擇要出現的是註解或尺寸
- 45 度內容 - 角度 x 長度；長度 x 角度；長度 x 長度
- 非 45 度樣式 - 尺寸；註解
- 非 45 度內容 - 角度 x 長度；長度 x 角度；長度 x 長度
- 長度精度 - 在長度值中數字的位數
- 角度精度 - 在角度值中數字的位數
座標尺寸
變更工程圖座標尺寸樣式。
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ANSI - Displays leading lines from the ordinate dimensions.
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ISO - Displays leading lines from the ordinate dimensions and additional arrows that connect the increasing ordinate values from the origin point.
工程圖中的左側為 ANSI 座標尺寸樣式，右側為 ISO 樣式
如果當您建立新工程圖時使用 ANSI 或 ISO 範本，會分別將座標尺寸樣式預設為 ANSI 或 ISO。
直徑與半徑尺寸
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Show dimension line - Displays radial and diameter dimension lines inside the circle or arc. By default, this option is checked when creating a drawing with an ISO template, and unchecked when creating a drawing with an ANSI template.
核取「顯示尺寸線」(左圖) 與未核取「顯示尺寸線」的環狀工程圖 (右圖)。
註記
若要存取「註記」的屬性，請按一下「工程圖屬性」面板上方的第三個圖示。可從該處編輯工程圖中的字型、文字高度、箭頭長度和類型、以及每種註記類型的色彩：您可以一次提供所有註記的預設，或分別設定註解、標註、基準、幾何公差、表面加工符號、熔接符號、鑽孔標註與彎折註解 (鈑金)。
對各種工程註記圖元類似的屬性將說明如下，特定於某一註記類型的屬性將於這個部分後的次標題中說明。
- Font - Select the font of choice for each annotation type.
- Text height - Select the size of choice for each annotation type.
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Color - To edit colors for any annotation entity, click the corresponding color block to access the color dialog:
- Select Palette to choose a color or enter a hex or RGB codes. Use the Mixer panel to drag to a general color area and then enter a specific hex or RGB code.
On either the Palette or Mixer panels you can click the plus sign under Custom colors to save the currently specified color value as a custom color for later use.
註解
指定所有註解屬性的預設，包括字型、文字高度與色彩。
您也可以指定：
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隱藏屬性預留位置 (在標題方塊中以 ---- 顯示)
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隱藏屬性背景 (如在標題方塊中所示，預設是灰色的)
請注意，根據預設，所有匯出的工程圖不再包含工程圖與圖頁屬性的預留位置 ("----")。
旗標註解
指定所有旗標註解的預設，包括「字型」、「邊框形狀」與「色彩」。
標註
指定所有標註的預設，要放置在空間中或是附加至幾何上，並包括字型、文字高度與色彩。
工程圖中的標註是與 BOM 的「項目編號」欄相對應
基準
指定所有基準屬性的預設，包括字型、文字高度、基準大小 (三角形的大小) 與色彩。
幾何公差
指定所有幾何公差的預設，包括字型、文字高度與色彩。
表面加工符號
指定所有表面加工符號的預設，包括字型、文字高度與色彩。
熔接符號
在「註記」功能表的底部變更熔接符號的標準。這個功能表會變更用於工程圖中熔接符號的預設標準。這個標準是與工程圖標準分開獨立的，因此不會改變工程圖的標準。例如，在使用 ANSI 標準的工程圖中，您可以變更這個設定來在工程圖中全部使用 ISO 熔接符號。
彎折註解
變更附加至鈑金視圖上彎折註解的格式 (包括字型、文字高度與色彩)。工程圖中的彎折註解是來自在 Part Studio 中指定的彎折規格：
鑽孔標註
Change the formatting for hole callouts attached to sheet metal views, including font, text height and color. Hole callouts are applied to a drawing of a sheet metal flat pattern through the Dimensions dropdown menu, Hole callout tool 
.
視圖
若要存取「視圖」功能表，請按一下「工程圖屬性」面板上方的第四個圖示。在這個功能表中您可以編輯工程圖的投影角度，顯示邊線、相切邊線、隱藏邊線、切割線、箭頭、視圖標籤與其他項目的色彩與粗細。
對各種工程視圖類似的屬性將說明如下，特定於某一視圖類型的屬性將於這個部分後的次標題中說明。
- Line - Choose a line style, thickness, and color.
- Arrowhead - Choose an arrowhead size and style.
- Labels - Choose a font, font size, formatting, and color.
- Color - To edit colors for any annotation entity, click the corresponding color block to access the color dialog:
- Select Palette to choose a color or enter a hex or RGB codes. Use the Mixer panel to drag to a general color area and then enter a specific hex or RGB code.
On either the Palette or Mixer panels you can click the plus sign under Custom colors to save the currently specified color value as a custom color for later use.
所有視圖
在此處為所有的視圖類型選擇預設：剖面視圖、細部放大圖、斷開視圖與展開圖樣視圖：
- Projection angle - Specify which projection to use
- Visible edges - Specify the thickness and color of lines representing visible edges
- View labels - Specify the font, size, font treatment and color of all view labels
插入視圖預設
設定隱藏閾值之下的特徵藉以簡化工程圖中的幾何，這個設定僅會影響新近插入的視圖。
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None - No simplification setting is applied.
Automatic - Default. Finds the best view simplification settings based on the geometry of the part and automatically uses those settings to display the part or assembly.
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Absolute - Enter a number in the length units of the drawing to indicate that any feature smaller than the value will be simplified within the view. If whole parts are smaller than the threshold value, those parts will be missing from the view. This is useful for removing excessive details not needed for drawing purposes (for example, a large number of very small features or components).
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Ratio to studio - Enter a percentage of the size of the Part Studio or Assembly below which the feature will be simplified within the view. If whole parts are smaller than the threshold value, those parts will be missing from the view. This is useful for removing excessive details not needed for drawing purposes (for example, a large number of very small features or components).
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Ratio to part - Enter a percentage of the size of the part below which the feature will be simplified within the view. This setting aims to preserve parts in a view, while simplifying the detail within those parts. This is useful if you intend to ensure all the parts are present to facilitate detailing actions, such as placing callouts.
隱藏邊線
指定代表隱藏邊線的線條粗細與色彩，以及虛線的間距。
相切線
指定代表相切線的線條粗細與色彩，以及虛線的間距。
爆炸線
指定爆炸視圖中爆炸線的粗細，以及虛線的間距。
剖面視圖
指定這些項目的預設：
- Hatch pattern - Specify the default type and pattern for the hatch marks
- Hatches - Specify the default line size and color for hatch marks
- Cutting lines - Specify the default line size and color for cutting lines
- Arrowhead - Specify the default size and arrowhead type (filled, unfilled, or open)
- Cutting line label - Specify the font, size, font treatment and color of all cutting line labels
在上方圖例中剖面視圖的剖面線變為金色 (變更也會沿續至細部放大圖中)，切割線上的箭頭改用較大的尺寸
細部放大圖
指定這些項目的細節：
- Detail profile lines - Specify the default line size, color, and style (Phantom, Dashed, or Solid) of the detail profile lines.
- Arrowhead - Specify the default size and arrowhead type (filled, unfilled, or open).
- Detail profile label - Specify the font, font size, style, and color of all detail profile labels.
- Detail profile style - Select In line, Connected, or Leader.
- Detail view profile - Deselect the check box to remove the outline surrounding the Detail view.
輔助視圖
指定這些項目的細節：
- Show view reference indicator - Show/hide the view reference indicator.
- View reference format - Click the format image to switch the view reference indicator format between line style and arrow style.
- Viewing lines - Specify the default view reference indicator line thickness and color.
- Arrowhead - Specify the default size and arrowhead type (filled, unfilled, or open).
- Viewing line label - Specify the font, size, font treatment and color of all viewing line labels.
- View label prefix - Enter a prefix to display before the view label.
- View label style - Select between A-A and A.
- View label suffix - Enter a suffix to display after the view label.
以棕色方框顯示的輔助視圖，檢視平面與參考指標以藍色顯示，標籤則是黑色的。
您也可以使用「輔助視圖」的箭頭樣式做為參考點來建立尺寸或線到線的角度尺寸。在建立「輔助視圖」之後，開啟屬性面板 > 視圖 > 輔助視圖，然後選擇「箭頭樣式」做為「視圖參考格式」，之後您就可以使用「尺寸」工具建立角度尺寸。
斷開視圖
指定折斷線的預設線條粗細與色彩。
在上方的圖例中折斷線的粗細是 0.50mm，顏色則是藍色。
展開圖樣視圖
對於鈑金展開圖樣的工程圖，請指定所有彎折線的預設線條粗細，以及上彎線與下彎線的色彩。
在上方的圖例中所有的彎折線有 0.50mm 的值，且上彎線的色彩是指定為紅色
幾何建構線
若要存取「幾何建構線」功能表，按一下「工程圖屬性」面板上方的第五個圖示。在這個功能表中您可以編輯工程圖中心線與中心符號線的色彩與粗細，以及工程圖中虛擬交角的樣式、色彩與粗細。使用 Part Studio 中草圖的部分來編輯帶入工程圖中的草圖格式。
- Created in drawing - Specify defaults for construction geometry you create in the drawing:
- Virtual sharps - Specify the visual treatment for all virtual sharps as Centermark or Edge extension, shown below, respectively:
- Sketch geometry - Specify the default line size and color for all sketches added to the drawing.
- Virtual sharps - Specify the visual treatment for all virtual sharps as Centermark or Edge extension, shown below, respectively:
- Part Studio sketches - Specify defaults for the geometry brought in as a Part Studio sketch.
上方的圖例顯示在對話方塊中為幾何建構線做出的選擇；右邊的圖片顯示紫色的虛擬交角與綠色的邊線延伸
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Centermarks - For automatic or manual centermarks, specify the default line color and thickness, mark size, gap size, and whether or not to extend the lines. For circular centermarks, specify whether to show a bolt circle, radial lines, and/or the pattern centermark.
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若要修改自動或手動中心符號線的長度，請啟用延伸線。將游標移動至中心符號線上暫留以顯示每條線尾端的抓點。在其中一個抓點上按一下並向外或向內拖曳，然後將抓點放置在新的位置上。所有的線條會同時移動，若要單獨移動一條線，請按住 Shift，然後拖曳後放置。
移動游標至線上暫留以顯示抓點 (上方中第一個圖片所示)， 按一下並拖曳抓點來向外延伸所有中心符號線 (上方中第二個圖片所示)，按住 Shift，然後按一下並拖曳抓點來向上延伸單一線條 (上方中第三個圖片所示)
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當拖曳自動或手動中心符號線抓點到邊線上時，會顯示一個紅色菱形的抓取點，讓您可以將中心符號線延伸線放置在這個抓取點的位置上 (請件下方圖片)。僅會在同時移動所有中心符號線延伸線時顯示抓取點。當 Shift+拖曳抓點來移動單一延伸線時不會顯示。
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- Centerlines - Specify the default line size and color, as well as the spacing of the dashes.
格式
若要存取「格式」功能表，按一下「工程圖屬性」面板上方內的第六個圖示。這個功能表會啟用 / 停用在工程圖邊框框架、邊框區域與標題區塊中對物件的選取。對新工程圖的預設是「鎖定」的；意即您無法馬上在標題區塊、邊框或邊框區域中選擇物件。
一開始時工程圖的此項屬性應是設定為解除鎖定的，這樣使用者可以選擇在標題區塊或邊框中的物件。
如果欄位值變更，則當標題區塊被鎖住時，會更新標題區塊的內容。
如果您將一個圖元移動到標題區塊、邊框或邊框區域中，且格式是鎖住的，則您必須先將圖元移回工程圖中才能編輯圖元。
- Locked - Lock or unlock the title block to disallow editing or allow editing.
- Border frame - Specify the color and thickness of the drawing's inner border
- Border zone - Specify the color and thickness of the labels inside the drawing's border zone
- Title block - Specify the color of lines and content of the title block, and the thickness of the lines
In the title block and border, entities in gray inherit their values from document data or properties. However, right-click on an entity to access the context menu for that entity. Select Edit note to edit the entity. Hover over a field (or click on it) to see what the corresponding property is. You have the ability to delete the field (property) and insert your own text if you wish. Use the Insert drawing property icon in the Note edit box to insert a different property:
這個圖例顯示正在編輯標題區塊中的欄位 (從環境選單中選擇 [編輯註解])，然後使用 [插入工程圖屬性] 指令來插入新的欄位
表格
若要存取「表格」功能表，請按一下「工程圖屬性」面板上方的倒數第二個圖示。您可以變更材料表 (BOM) 以及您在工程圖中建立的所有其他表格，例如鑽孔表格。
- All tables - Specify default values for all tables, including:
- Horizontal padding - Specify the default horizontal thickness value for table cells. Default is 0.06 in.
- Vertical padding - Specify the default vertical thickness value for table cells. Default is 0.06 in.
- BOM tables - Specify default values for bill of material tables, including:
- Line thickness - Specify the default thickness of the lines.
- Font - Specify the default font type.
- Header row text - Specify the default font size, font treatment, and color for the header row.
- Content row text - Specify the default font size, font treatment, and color for the content rows.
- Custom tables - Specify default values for custom tables, including:
- Line thickness - Specify the default thickness of the lines.
- Font - Specify the default font type.
- Header row text - Specify the default font size, font treatment, and color for the header row.
- Content row text - Specify the default font size, font treatment, and color for the content rows.
- Cut list tables - Specify default values for cut list tables, including:
- Line thickness - Specify the default thickness of the lines.
- Font - Specify the default font type.
- Header row text - Specify the default font size, font treatment, and color for the header row.
- Content row text - Specify the default font size, font treatment, and color for the content rows.
- Hole tables - Specify default values for hole tables, including:
- Line thickness - Specify the default thickness of the lines.
- Font - Specify the default font type.
- Header row text - Specify the default font size, font treatment, and color for the header row.
- Content row text - Specify the default font size, font treatment, and color for the content rows.
- Indicator style - Select a standard for the hole indicator: ANSI or ISO.
- Indicator arrowhead - Enter or select a size for the indicator arrowhead.
- Indicator lines - Select a thickness and a color for the lines.
- Tags - Specify characteristics of the text for the hole tags: font, size, formatting (bold, italic, or none), and color.
- Revision tables - Specify default values for revision tables, including:
- Line thickness - Specify the default thickness of the lines.
- Font - Specify the default font type.
- Title row text - Specify the default font size, font treatment, and color for the table title row.
- Header row text - Specify the default font size, font treatment, and color for the table header row.
- Content row text - Specify the default font size, font treatment, and color for the table content rows.
- Revision callout - Specify the default shape of the callout, the number of characters, and the font, size, color, and treatment.
- Tables - Specify default values for tables you create in the drawing, including:
- Line thickness - Specify the default thickness of the lines.
- Font - Specify the default font type.
- Title row text - Specify the default font size, font treatment, and color for the table title row (if applicable).
- Header row text - Specify the default font size, font treatment, and color for the table header row (if applicable).
- Content row text - Specify the default font size, font treatment, and color for the table content rows.
若要獨立於表格屬性之外編輯表格的儲存格，可點按儲存格空白區域來開啟「儲存格」編輯面板：
連按兩下表格中的文字來在表格屬性之外獨立編輯任何儲存格中的文字：
檢查項目
若要存取檢查項目功能表，請按一下「工程圖屬性」面板上方的最後一個圖示。您可以變更加入到工程圖中檢查項目的外觀。
- Item parsing - Specify the default behavior of Inspection item parsing. Parameter (default) separates Hole callout and Chamfer dimensions into separate parameters (see example below left), and Row consolidates Hole callout and Chamfer dimensions together into a single row (see example below right). When adding Inspection items, the row or parameter is highlighted, depending on selection:
- Font - Specify the default font type for the inspection item.
- Text - Specify the size and treatment of the text displayed as part of the inspection item.
- Border shape - Select the desired shape for the inspection item.
- Border size - Select the desired size of the inspection item shape.
- Border color - Select the color of the inspection item.
- Solid fill - Check the box to indicate a solid inspection item, and select the color.
- Exclude callouts - By default, if using automatic inspection items, inspection item numbers are assigned to callouts when callouts are created. Check this box if you wish to exclude callouts from being assigned inspection item numbers.
您可以使用「參數」與「列」的組合。例如，使用預設的「項目剖析」> 「參數」設定，將兩個檢查項目加至兩個倒角尺寸參數中，然後將「項目剖析」轉換為「列」，再加入第三個檢查項目到倒角尺寸列中。
更新與鎖定工程圖屬性
在 Onshape 中您可以使用「工程圖屬性」面板底部的功能 (下圖中以紅色輪廓線框出) 來匯入您已建立的工程圖範本以變更工程圖的屬性。您也可以使用 [鎖住工程圖屬性] 核取方塊來避免意外編輯工程圖屬性。
若要使用現有的 Onshape 工程圖範版來更新屬性，請開啟「工程圖屬性」面板。
Click the Select a DWT icon 
to the right of Update properties from a template...to open the Select a DWT dialog box:
從目前的文件中選擇一個 DWT
- Click
at the top of the dialog. - Type in the Search files bar to find a file, or select one from the list below it.
- To import a DWT from your desktop, click
![[匯入] 圖示](Resources/Images/icons/importfileicon@1x.png)
Import at the bottom of the dialog box, select the file you wish to import, and click Open.
使用對話方塊最上方「其他文件」之下的三個圖示，分別說明如下：
View released items - Click the View released items icon to list all released items for you to choose from.
Create version - Click the Create version icon to open the Create version dialog box:
Adjust the name and/or description of your version, and click Create to create the version, or Create version and edit properties to open the Properties dialog:
Adjust the properties of your version, click Apply to apply your changes, or click Save to apply the changes and close the Properties dialog.
Click Close to close the Properties dialog without applying any changes.
Version graph - Click the Version graph icon to select a different version of the document from the version graph.
從其他文件中選擇一個 DWT
- Click
at the top of the dialog. - 使用搜尋列，或是點按下方選項之一來從 Onshape 的其他文件選擇一個 DWT。
My Onshape - Select a DWT from a document in your Onshape.
Recently opened - Select a DWT from your recently opened documents.
Created by me - Select a DWT fr om documents created by you.
Shared with me - Select a DWT from documents shared with you.
- To import a DWT from your desktop, click Import...at the bottom of the dialog box, select the file you wish to import, and click Open.
在您匯入工程圖範本之後，系統會自動更新屬性。
Use the Format painter to apply the format of one dimension or annotation to additional dimensions or annotations.