Hole

1. Create a sketch with sketch points, then click the Hole feature icon () on the Features toolbar.

   

2. Select a measurement, either Inch or Metric.

3. Select a hole style:
   • Simple - A uniform-diameter drilled hole.
   • Counterbore - A cylindrical flat-bottomed drilled hole that enlarges another coaxial drilled hole.
   • Countersink - A drilled hole with a conical relief at the top.
4. Select points in the sketch (including corners of geometry, line ends, spline points, circle centers, etc.) where the hole centers are to be placed.

   

   • You can box-select multiple points.
   • You can click the Mate connector icon () to select or create implicit Mate connectors as points instead of sketch points:

     

     Once a Mate connector is selected, click the Mate connector icon () to open a dialog to edit the Mate connector:

     

   • Alternatively, click on a sketch and to automatically select all the points on the sketch, not including those used as construction geometry.

     

5. With focus in the Merge scope field, select the part(s) to contain the holes.
6. Select from the following Hole types and hole type specifications that suit your needs. Not all Hole type specifications are available for all Hole types, and depend upon your selections:
   • Drilled - Creates a drilled hole.
     • Drill size - Select a Drill size from the dropdown list.
   • Clearance - Creates a clearance hole.
     • Size - Select a Clearance size from the dropdown list.
     • Fastener fit - Select from Close, Free, Close (ASME), Normal (ASME), Loose (ASME)
   • Tapped - Creates a tapped hole.
     • Tap type - Select either Straight tap or Tapered pipe tap.
     • Size - Select a tapped hole size from the dropdown list.
     • Threads/inch - Select the number of threads per inch (tpi) setting from the dropdown list.
     • Fastener fit - Available only for Straight tap Tap type when 2 or more parts are selected in the Merge scope field. Select from None, Close, Free, Close (ASME), Normal (ASME), Loose (ASME).
     • Thread class - Optionally, select the checkbox to toggle Thread class on or off. When toggled on, the appropriate Inch or Metric classes will be available in the dropdown.
   • PEM^® - PennEngineering^® fasteners. This option is not available for counterbored or countersunk holes.
     • Fastener - Select from Self-clinching nuts, Self-clinching standoffs, Self-clinghing studs & pins
     • Fastener type - Select from S™/SS™/CLS™/CLSS™/SP™ nuts, CLA™ free running locknuts, S-RT™ Free-running locknuts, SL™ TRI-DENT® Prevailing torque locknuts, Self-clinching nuts, H™ Nuts/HNL™ Prevailing torque locknuts, SH™ Hard panel nuts, SMPS™/SMPP™ Nuts.
     • Size - Select a tapped hole size from the dropdown list.
     • Fastener fit - Clearance.
7. Enter the diameter tolerance controls for the hole:
   • Diameter - Enter a diameter value for the hole.
   • Precision - Select a precision for the hole, either Workspace precision or another precision value from the dropdown list.
   • Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, Max, Fit, Fit with tolerance, Fit (tolerance only).
     • Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
     • Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
     • Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
     • Standard - Available for the Fit Tolerance type. Select the ANSI or ISO standard from the dropdown list.
     • Fit type - Available for the Fit Tolerance type. Select User defined, Clearance, Transition, or Interference from the dropdown list.
     • Hole class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Select H5, H6, H7, H8, H9, H10, H11 from the dropdown list.
     • Shaft class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types when the ISO Standard is selected. Select a Shaft class from the dropdown list.
8. Select the Start plane for the hole:
   • Start from part - the hole begins from the part face.
   • Start from sketch plane - The hole begins from the sketch plane.
   • Start from selected plane - The hole begins from a selected plane.
     • Hole start plane or Mate connector - Select the entity (plane or Mate connector) from which the hole begins.

   These options enable you to control the depth end at the same location on the part when the holes start at different heights. For example, all the sketch points for the holes are on one plane:

   

   For a counterbore hole with a depth of 1 inch, when the holes do not start from the sketch plane, the shorter hole contains only the counterbore while the deepest hole contains the counterbore and bolt shaft:

   

   But when the holes are started from the sketch plane the shaft is placed first and the counterbore is shortened:

   

   The same scenario holds true for countersink holes. Simple holes are just adjusted for depth.

9. Select a Termination (end) condition. For all termination end conditions, click the Opposite direction arrow () to flip the hole direction.  
   • Blind - The hole ends at a specified depth in the selected part.
     • Depth - Enter the depth value for the hole, inclusive of the counterbore or countersink depth.
       • Precision - Select a precision for the hole depth, either Workspace precision or another precision value from the dropdown list.
       • Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, and Max.
         • Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
         • Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
         • Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
     • Counterbore diameter - For counterbore holes, enter the diameter value for the hole tip, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Counterbore depth - For counterbore holes, enter the depth value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Countersink diameter - For countersink holes, enter the diameter value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Countersink angle - For countersink holes, enter the angle value of the hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Tapped depth - For tapped holes, the full thread depth of a tapped hole, in document units (or specify other units). Precision and Tolerance type controls have the same options as listed above, under the Depth tolerance controls.
     • Tap clearance - For blind tapped holes, the number of thread pitch lengths between the bottom of the Tapped depth and bottom of the hole.

     Zero and negative values are accepted for the lower and upper bounds when Limits or Deviation tolerance type is selected. An error occurs if the computed lower bound is greater than the computed upper bound. The computed upper and lower bounds can be equal.

   • Up to next - Up to the next face or faces encountered.
     • Offset from tip - Check to enter an offset distance value from the hole tip. Click the Opposite direction arrow () to flip the offset.
     • Depth - Multiple.
     • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
   • Up to entity - Up to a selected entity or Mate connector.
     • Up to entity or Mate connector - Select the entity (for example, a face or plane) or Mate connector ().
     • Offset from tip - Check to enter an offset distance value from the hole tip. Click the Opposite direction arrow () to flip the offset.
     • Depth - Multiple.
     • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
   • Through all - Completely through the part(s) selected in the Merge scope.
     • Tap through all - For tapped holes, keep checked to create thread for the full length of the hole. Uncheck to specify:
       • Tapped depth - Enter a custom thread depth.
       • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
10. Select the Tip angle style for the hole. Options are 118 degrees, 135 degrees, Flat, or Custom to customize your own.
    • Tip angle - For custom holes, enter a Tip angle value.
    • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
11. The name of the Hole feature automatically updates to reflect the hole's settings.
    • To rename the hole, hover over the Name field in the Hole dialog, and click the Pencil icon that appears. Type a new name, and then press enter.
    • To change a hole name back to the auto-generated default, hover over the Name field in the Hole dialog, click the Pencil icon, delete everything in the Name field, and then press enter.
    
12. Click the checkmark icon () to create the hole.

A uniform-diameter drilled hole:

Holes can be created on active sheet metal features. Counterbore or countersink holes can also be added to sheet metal, as shown below:

The calculation of the hole can impact multiple sheet metal parts based on the merge scope of the hole feature. In the example below, 2 sheet metal parts are created with flanges that are touching. When a countersink hole is added to the model, and both parts are included in the hole's Merge scope, the result is a countersunk hole through both parts:

Blind

To a specified depth in the selected part.

A simple hole with Blind selected as the termination condition and a depth set to 10 inches, passing through just the top two plates:

Up to next

Up to the next face or faces encountered in the specified direction.

A simple hole with Up to next selected as the termination condition:

Up to entity

Up to the next (or selected) entity encountered in the specified direction.

A simple hole with Up to entity selected as the termination condition and the dark blue part as the selected entity:

Through all

Completely through the selected part or parts.

A simple hole with Through set as the termination condition and all four plates selected:

When using Up to next or Up to entity end conditions, if the Tapped depth input is greater than the minimum computed Hole depth, the Tapped depth is readjusted, and the following message displays:

• If the computed hole depth is greater than the input tapped depth, the tapped depth is not readjusted.

• If the computed hole depth is smaller than the input tapped depth, the tapped depth value is adjusted to the computed hole depth value.

For through holes, both the computed hole depth and tapped depth values display THRU on the Hole/thread callout in a drawing:

• All material is cleared between the point on the sketch plane and the hole:
• If you change the sketch, the hole feature recomputes.
• This feature includes logic to determine a good starting depth for the hole, useful for curved or irregular surfaces. This is the default. If you want the hole start to be located at the sketch plane, check this box (effectively turning off the starting depth logic). Checking this box also allows you to create overlapping holes.
• In the case of collision or overlap of hole features or the hole does not lie completely on the target part, the hole will be drilled at 0 depth relative to the sketch plane.

• If a standard does not provide a counterbore, countersink or tap diameter, these values will be reset if they are out of range.

• With two or more parts selected, and Tapped > Fastener fit set to something other than None, the initial holes are clearance holes and the final hole is tapped (this method replaces the deprecated Blind in last option).

1. Tap the Hole tool ().

   

2. Select a measurement, either Inch or Metric.

3. Select a hole style:
   • Simple - A uniform-diameter drilled hole.
   • Counterbore - A cylindrical flat-bottomed drilled hole that enlarges another coaxial drilled hole.
   • Countersink - A drilled hole with a conical relief at the top.
4. Select points in the sketch (including corners of geometry, line ends, spline points, circle centers, etc.) where the hole centers are to be placed.

   

   • You can tap the Mate connector icon () to select or create implicit Mate connectors as points instead of sketch points.
5. Tap Merge scope to select the part(s) to contain the holes.
6. Tap Hole type and select a Hole type, and then the specifications that suit your needs. Not all Hole type specifications are available for all Hole types.
   • Drilled - Creates a drilled hole.
     • Drill size - Select a Drill size from the dropdown list.
   • Clearance - Creates a clearance hole.
     • Size - Select a Clearance size from the dropdown list.
     • Fastener fit - Select from Close, Free, Close (ASME), Normal (ASME), Loose (ASME)
   • Tapped - Creates a tapped hole.
     • Tap type - Select either Straight tap or Tapered pipe tap.
     • Size - Select a tapped hole size from the dropdown list.
     • Threads/inch - Select the number of threads per inch (tpi) setting from the dropdown list.
     • Class - Depends on size selection. Select from 1B, 2B, or 3B.
     • Fastener fit - Available only for Straight tap Tap type when 2 or more parts are selected in the Merge scope field. Select from None, Close, Free, Close (ASME), Normal (ASME), Loose (ASME).
   • PEM^® - PennEngineering^® fasteners. This option is not available for counterbored or countersunk holes.
     • Fastener - Select from Self-clinching nuts, Self-clinching standoffs, Self-clinghing studs & pins
     • Fastener type - Select from S™/SS™/CLS™/CLSS™/SP™ nuts, CLA™ free running locknuts, S-RT™ Free-running locknuts, SL™ TRI-DENT® Prevailing torque locknuts, Self-clinching nuts, H™ Nuts/HNL™ Prevailing torque locknuts, SH™ Hard panel nuts, SMPS™/SMPP™ Nuts.
     • Size - Select a tapped hole size from the dropdown list.
     • Fastener fit - Clearance.
7. Enter the diameter tolerance controls for the hole:
   • Diameter - Enter a diameter value for the hole.
   • Precision - Select a precision for the hole, either Workspace precision or another precision value from the dropdown list.
   • Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, Max, Fit, Fit with tolerance, Fit (tolerance only).
     • Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
     • Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
     • Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
     • Standard - Available for the Fit Tolerance type. Select the ANSI or ISO standard from the dropdown list.
     • Fit type - Available for the Fit Tolerance type. Select User defined, Clearance, Transition, or Interference from the dropdown list.
     • Hole class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Select H5, H6, H7, H8, H9, H10, H11 from the dropdown list.
     • Shaft class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types when the ISO Standard is selected. Select a Shaft class from the dropdown list.
8. Select the Start plane for the hole:
   • Start from part - the hole begins from the part face.
   • Start from sketch plane - The hole begins from the sketch plane.
   • Start from selected plane - The hole begins from a selected plane.
     • Hole start plane or Mate connector - Select the entity (plane or Mate connector) from which the hole begins.

   These options enable you to control the depth end at the same location on the part when the holes start at different heights. For example, all the sketch points for the holes are on one plane:

   

   For a counterbore hole with a depth of 1 inch, when the holes do not start from the sketch plane, the shorter hole contains only the counterbore while the deepest hole contains the counterbore and bolt shaft:

   

   But when the holes are started from the sketch plane the shaft is placed first and the counterbore is shortened:

   

   The same scenario holds true for countersink holes. Simple holes are just adjusted for depth.

9. Select a Termination (end) condition. For all termination end conditions, tap the Opposite direction toggle to flip the hole direction.  
   • Blind - The hole ends at a specified depth in the selected part.
     • Depth - Enter the depth value for the hole, inclusive of the counterbore or countersink depth.
       • Precision - Select a precision for the hole depth, either Workspace precision or another precision value from the dropdown list.
       • Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, and Max.
         • Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
         • Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
         • Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
     • Counterbore diameter - For counterbore holes, enter the diameter value for the hole tip, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Counterbore depth - For counterbore holes, enter the depth value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Countersink diameter - For countersink holes, enter the diameter value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Countersink angle - For countersink holes, enter the angle value of the hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Tapped depth - For tapped holes, the full thread depth of a tapped hole, in document units (or specify other units). Precision and Tolerance type controls have the same options as listed above, under the Depth tolerance controls.
     • Tap clearance - For blind tapped holes, the number of thread pitch lengths between the bottom of the Tapped depth and bottom of the hole.

     Zero and negative values are accepted for the lower and upper bounds when Limits or Deviation tolerance type is selected. An error occurs if the computed lower bound is greater than the computed upper bound. The computed upper and lower bounds can be equal.

   • Up to next - Up to the next face or faces encountered.
     • Offset from tip - Tap the toggle to enter an offset distance value from the hole tip. Tap the Opposite direction toggle to flip the offset.
     • Depth - Multiple.
     • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
   • Up to entity - Up to a selected entity or Mate connector.
     • Up to entity or Mate connector - Select the entity (for example, a face or plane) or Mate connector ().
     • Offset from tip - Tap the toggle to enter an offset distance value from the hole tip. Tap the Opposite direction toggle to flip the offset.
     • Depth - Multiple.
     • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
   • Through all - Completely through the part(s) selected in the Merge scope.
     • Tap through all - For tapped holes, Keep the toggle on to create thread for the full length of the hole. Tap the toggle off to specify:
       • Tapped depth - Enter a custom thread depth.
       • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
10. Select the Tip angle style for the hole. Options are 118 degrees, 135 degrees, Flat, or Custom to customize your own.
    • Tip angle - For custom holes, enter a Tip angle value.
    • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
11. Tap the checkmark to create the hole.

A uniform-diameter drilled hole

Blind

To a specified depth in the selected part.

This shows a simple hole with Blind selected as the termination condition and a depth set to 10 inches. Thus, the hole is created 10 inches through the plates, and only passes through the top two plates.

Up to next

Up to the next face or faces encountered in the specified direction.

A simple hole with Up to next selected as the termination condition:

Up to entity

Up to the next (or selected) entity encountered in the specified direction.

A simple hole with Up to entity selected as the termination condition and the dark blue part as the selected entity:

Through all

Completely through the selected part or parts.

This shows a simple hole with Through set as the termination condition and all four plates selected. Thus, the hole is through all four plates.

• All material is cleared between the point on the sketch plane and the hole.
• If you change the sketch, the hole feature recomputes.
• This feature includes logic to determine a good starting depth for the hole, useful for curved or irregular surfaces. This is the default. If you want the hole start to be located at the sketch plane, toggle on Start from sketch plane (effectively turning off the starting depth logic). Toggling this option on also allows you to create overlapping holes.
• In the case of collision or overlap of hole features or the hole does not lie completely on the target part, the hole is drilled at 0 depth relative to the sketch plane.
• If a standard does not provide a counterbore, countersink, or tap diameter, these values are reset if they are out of range.
• With two or more parts selected, and Tapped > Fastener fit set to something other than None, the initial holes are clearance holes and the final hole is tapped (this method replaces the deprecated Blind in last option).

1. Tap the Hole tool ().

   

2. Select a measurement unit, either Inch or Metric.

3. Select a hole style:
   • Simple - A uniform-diameter drilled hole.
   • Counterbore - A cylindrical flat-bottomed drilled hole that enlarges another coaxial drilled hole.
   • Countersink - A drilled hole with a conical relief at the top.
4. Select points in the sketch (including corners of geometry, line ends, spline points, circle centers, etc.) where the hole centers are to be placed.

   

   • You can tap the Mate connector icon () to select or create implicit Mate connectors as points instead of sketch points.
5. Tap Merge scope to select the part(s) to contain the holes.
6. Tap Hole type and select a Hole type, and then the specifications that suit your needs. Not all Hole type specifications are available for all Hole types.
   • Drilled - Creates a drilled hole.
     • Drill size - Select a Drill size from the dropdown list.
   • Clearance - Creates a clearance hole.
     • Size - Select a Clearance size from the dropdown list.
     • Fastener fit - Select from Close, Free, Close (ASME), Normal (ASME), Loose (ASME)
   • Tapped - Creates a tapped hole.
     • Tap type - Select either Straight tap or Tapered pipe tap.
     • Size - Select a tapped hole size from the dropdown list.
     • Threads/inch - Select the number of threads per inch (tpi) setting from the dropdown list.
     • Class - Depends on size selection. Select from 1B, 2B, or 3B.
     • Fastener fit - Available only for Straight tap Tap type when 2 or more parts are selected in the Merge scope field. Select from None, Close, Free, Close (ASME), Normal (ASME), Loose (ASME).
   • PEM^® - PennEngineering^® fasteners. This option is not available for counterbored or countersunk holes.
     • Fastener - Select from Self-clinching nuts, Self-clinching standoffs, Self-clinghing studs & pins
     • Fastener type - Select from S™/SS™/CLS™/CLSS™/SP™ nuts, CLA™ free running locknuts, S-RT™ Free-running locknuts, SL™ TRI-DENT® Prevailing torque locknuts, Self-clinching nuts, H™ Nuts/HNL™ Prevailing torque locknuts, SH™ Hard panel nuts, SMPS™/SMPP™ Nuts.
     • Size - Select a tapped hole size from the dropdown list.
     • Fastener fit - Clearance.
7. Enter the diameter tolerance controls for the hole:
   • Diameter - Enter a diameter value for the hole.
   • Precision - Select a precision for the hole, either Workspace precision or another precision value from the dropdown list.
   • Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, Max, Fit, Fit with tolerance, Fit (tolerance only).
     • Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
     • Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
     • Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
     • Standard - Available for the Fit Tolerance type. Select the ANSI or ISO standard from the dropdown list.
     • Fit type - Available for the Fit Tolerance type. Select User defined, Clearance, Transition, or Interference from the dropdown list.
     • Hole class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Select H5, H6, H7, H8, H9, H10, H11 from the dropdown list.
     • Shaft class - Available for the Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types when the ISO Standard is selected. Select a Shaft class from the dropdown list.
8. Select the Start plane for the hole:
   • Start from part - the hole begins from the part face.
   • Start from sketch plane - The hole begins from the sketch plane.
   • Start from selected plane - The hole begins from a selected plane.
     • Hole start plane or Mate connector - Select the entity (plane or Mate connector) from which the hole begins.

   These options enable you to control the depth end at the same location on the part when the holes start at different heights. For example, all the sketch points for the holes are on one plane:

   

   For a counterbore hole with a depth of 1 inch, when the holes do not start from the sketch plane, the shorter hole contains only the counterbore while the deepest hole contains the counterbore and bolt shaft:

   

   But when the holes are started from the sketch plane the shaft is placed first and the counterbore is shortened:

   

   The same scenario holds true for countersink holes. Simple holes are just adjusted for depth.

9. Select a Termination (end) condition. For all termination end conditions, tap the Opposite direction toggle to flip the hole direction.  
   • Blind - The hole ends at a specified depth in the selected part.
     • Depth - Enter the depth value for the hole, inclusive of the counterbore or countersink depth.
       • Precision - Select a precision for the hole depth, either Workspace precision or another precision value from the dropdown list.
       • Tolerance type - Select a tolerance type for the hole from the dropdown list. Options are No tolerance, Symmetrical, Deviation, Limits, Min, and Max.
         • Deviation - Available for the Symmetrical Tolerance type. Enter a deviation value.
         • Upper - Available for the Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Tolerance type. Enter the upper tolerance value.
         • Lower -Deviation, Limits, Fit tolerance, Fit with tolerance, and Fit (tolerance only) Tolerance types. Enter the lower tolerance value.
     • Counterbore diameter - For counterbore holes, enter the diameter value for the hole tip, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Counterbore depth - For counterbore holes, enter the depth value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Countersink diameter - For countersink holes, enter the diameter value of the enlarged hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Countersink angle - For countersink holes, enter the angle value of the hole, as well as Precision and Tolerance controls, which are the same as those found above, under Blind > Depth.
     • Tapped depth - For tapped holes, the full thread depth of a tapped hole, in document units (or specify other units). Precision and Tolerance type controls have the same options as listed above, under the Depth tolerance controls.
     • Tap clearance - For blind tapped holes, the number of thread pitch lengths between the bottom of the Tapped depth and bottom of the hole.

     Zero and negative values are accepted for the lower and upper bounds when Limits or Deviation tolerance type is selected. An error occurs if the computed lower bound is greater than the computed upper bound. The computed upper and lower bounds can be equal.

   • Up to next - Up to the next face or faces encountered.
     • Offset from tip - Tap the toggle to enter an offset distance value from the hole tip. Tap the Opposite direction toggle to flip the offset.
     • Depth - Multiple.
     • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
   • Up to entity - Up to a selected entity or Mate connector.
     • Up to entity or Mate connector - Select the entity (for example, a face or plane) or Mate connector ().
     • Offset from tip - Tap the toggle to enter an offset distance value from the hole tip. Tap the Opposite direction toggle to flip the offset.
     • Depth - Multiple.
     • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
   • Through all - Completely through the part(s) selected in the Merge scope.
     • Tap through all - For tapped holes, Keep the toggle on to create thread for the full length of the hole. Tap the toggle off to specify:
       • Tapped depth - Enter a custom thread depth.
       • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
10. Select the Tip angle style for the hole. Options are 118 degrees, 135 degrees, Flat, or Custom to customize your own.
    • Tip angle - For custom holes, enter a Tip angle value.
    • Precision and Tolerance type controls - Same options as those found above, under Blind > Depth.
11. Tap the checkmark.

A uniform-diameter drilled hole

Blind

To a specified depth in the selected part.

This shows a simple hole with Blind selected as the termination condition and a depth set to 10 inches. Thus, the hole is created 10 inches through the plates, and only passes through the top two plates.

Up to next

Up to the next face or faces encountered in the specified direction.

A simple hole with Up to next selected as the termination condition:

Up to entity

Up to the next (or selected) entity encountered in the specified direction.

A simple hole with Up to entity selected as the termination condition and the dark blue part as the selected entity:

Through all

Completely through the selected part or parts.

This shows a simple hole with Through set as the termination condition and all four plates selected. Thus, the hole is through all four plates.

• All material is cleared between the point on the sketch plane and the hole.
• If you change the sketch, the hole feature recomputes.
• This feature includes logic to determine a good starting depth for the hole, useful for curved or irregular surfaces. This is the default. If you want the hole start to be located at the sketch plane, toggle on Start from sketch plane (effectively turning off the starting depth logic). Toggling this option on also allows you to create overlapping holes.
• In the case of collision or overlap of hole features or the hole does not lie completely on the target part, the hole is drilled at 0 depth relative to the sketch plane.
• If a standard does not provide a counterbore, countersink, or tap diameter, these values are reset if they are out of range.
• With two or more parts selected, and Tapped > Fastener fit set to something other than None, the initial holes are clearance holes and the final hole is tapped (this method replaces the deprecated Blind in last option).