疊層拉伸

1. Click .

   

2. 選擇 [實體] 建立類型。

Onshape 會記住選取的項目 (實體、曲面或薄件)，在後續的操作中打開對話方塊時即會有之前選取的項目。

3. 指定「結果」操作類型：
   • New - Create a new solid.
   • Add - Add to an existing solid.
   • Remove - Subtract from an existing solid.
   • Intersect - Keep only the intersection of two (or more) solids.
4. Select profiles (a region, face, edge, or point) and then optional cross-sections (in order of the loft direction) and finally the end (region, face, edge, or point).

   To select a set of tangentially connected curves as a single chain, click the arrow next to the desired selection in the dialog to expand the selection field. (A blue field is an active field.) Select more curves to create a composite selection.

   For example: To select both circles in the end loft position, select the first circle, then click in the field where the first selection appears and then click the second selection:

   

5. To refine the shape further, select a Start or End Profile condition to define the derivative constraints on the start and end profiles:
   1. Normal to profile - Causes the loft to touch the profile with tangents parallel to the profile's normal

      

   2. Tangent to profile - Causes the loft to touch the profile tangent to the profile plane.

      

   3. Match tangent - Causes the loft to match the tangents of model faces adjacent to the profile face (if available). Optionally, when selected, the Adjacent faces field is enabled. Pick any face in which underlying geometry is coincident with at least one profile part's curve (the face and edge do not need to intersect or be part of the same part).
   4. Match curvature - Causes the loft to match the curvature of model faces adjacent to the profile face (if available). Optionally, when selected, the Adjacent faces field is enabled. Pick any face in which underlying geometry is coincident with at least one profile part's curve. (The face and edge do not need to intersect or be part of the same part.)
6. Optionally, use a guide curve or curves for the loft to follow; it is not necessary for the guide curves to be touching the outsides of the profiles, only for them to intersect.
   1. Check the Guides and continuity box.
   2. 選擇要用來做為導引的一或多條曲線。
   3. (Optional) To select tangentially connected curves as a single guide, click the down arrow next to the selected guide to open the field for more selections.
      
      1. Make additional selections:
         

         • 1 and 2: Each of these is a single guide selection (“Edge of Loft 1” and “Edge of Sketch 3”).

         • 3: Click the arrow next to the guide name to expand the field.

         • 4: The blue highlighting indicates that field is active. At this point, you can select more adjacent curves to create a composite guide selection.

      2. (Optional) For further definition, use the Continuity condition on the guide. Continuity can be:
         • Normal to guide - Causes the loft to touch the guide with tangents parallel to the guide's normal.
         • Tangent to guide - Causes the loft to touch the guide with tangents on the guide's plane.
         • Match tangent - Causes the loft to match the face tangent of the guides adjacent to the profile.
         • Match curvature - Causes the curvature of the loft faces to match the curvature of the guides adjacent to the profile.

         Make sure that your sketch is consistent with what you are selecting, if the sketch is inconsistent with Match tangent and it is selected, the loft will fail. The same is true for Match curvature.

7. To create a centerline equivalent, select a Path for the loft to follow (and create intermediate sections along the path for the loft to reference).
   1. 按一下「路徑」旁的方塊。
   2. Select edges, curves, and sketches to act as the path (centerline guide) of the loft.
   3. 指定沿路徑要使用的剖面數量 (居間剖面數)。使用的剖面數量越多，路徑會更精準地進行。

   For example: Straight line selected as the path, section count = 3

   

   選取樣條做為路徑，剖面數量 = 10

   

8. Optionally, select Connections to have more control on the twist of the resulting surface. If there are guides, those are used for alignment, if not Onshape estimates the proximity within the existing vertices. It is best to have at least two vertices on each profile and use the matching vertices to control twist.
   1. Click Connections. The automatic connections are displayed in magenta. Automatic connections are only visible if there are no Match connection entries:

      

   2. Select an alternate set of vertices/edges to use:

      

      每個連接必須要有兩個選取項目。若要為連接加入第二個選取項目，請按一下「頂點或邊線」方塊 (點選時會變為藍色)。若要加入另一組連接，請先點按「連接」方塊 (點選時也會變為藍色)，然後再選取第二對的頂點/邊線。

      

   3. Once a connection is created, you can use the manipulator to drag to adjust the resulting shape (also shown in the image above).

9. Optionally, select Show isocurves to show a mesh overlay on the loft faces. The Count determines the number of isocurves per face.

   

10. 對於「加入」、「移除」或「相交」結果的操作，選擇性地核取「全部合併」，或是選擇一個「合併範圍」來選取要與疊層拉伸零件合併的零件。詳細資訊請參考下方的「合併範圍」。
11. Click .

1. Click .

   

2. Select Surface Creation type.

Onshape 會記住選取的項目 (實體、曲面或薄件)，在後續的操作中打開對話方塊時即會有之前選取的項目。

3. 指定「結果」操作類型：
   • New - Create a new surface.
   • Add - Add to an existing surface.

4. Select Profiles (a region, face, edge, or point) and then optional cross-sections (in order of the loft direction) and finally the end (region, face, edge, or point).

   To select a set of tangentially connected curves as a single chain, click the arrow next to the desired selection in the dialog to expand the selection field. (A blue field is an active field.) Select more curves to create a composite selection.

   

5. To refine the shape further, select a Start or End profile condition to define the derivative constraints on the start and end profiles:
   1. Normal to profile - Causes the loft to touch the profile with tangents parallel to the profile's normal.
   2. Tangent to profile - Causes the loft to touch the profile with tangents on the profile plane.
   3. Match tangent - Causes the loft to match the tangents of model faces adjacent to the profile face (if available). Optionally, when selected, the Adjacent faces field is enabled. Pick any face in which underlying geometry is coincident with at least one profile part's curve (the face and edge do not need to intersect or be part of the same part).
   4. Match curvature - Causes the loft to match the curvature of model faces adjacent to the profile face (if available). Optionally, when selected, the Adjacent faces field is enabled. Pick any face in which underlying geometry is coincident with at least one profile part's curve. (The face and edge do not need to intersect or be part of the same part.)

6. Trim profiles - Trim the loft operation to the intersection of the profiles and the guides, along the profiles. The image below shows the profiles trimmed, and the Guides selected:

   

   下圖的圖片顯示同時選取了 [修剪導引] 與 [修剪輪廓]，會將疊層拉伸同時沿著導引與輪廓修剪：

   

7. Optionally, use a guide curve or curves for the loft to follow; guide curves must be touching the outsides of the profiles, not the centers.
   1. Check the Guides and continuity box.
   2. 選擇要用來做為導引的一或多條曲線。
   3. To select tangentially connected curves as a single guide, click the down arrow next to the selected guide to open the field for more selections.
      
      1. Make additional selections:
         
         

         • 1 and 2: Each of these is a single guide selection (“Edge of Loft 1” and “Edge of Sketch 3”).

         • 3: Click the arrow next to the guide name to expand the field.

         • 4: The blue highlighting indicates that field is active. At this point, you can select more adjacent curves to create a composite guide selection.

      2. (Optional) For further definition, use the Continuity condition on the guide. Continuity can be:

         • Normal to guide - Causes the loft to touch the guide with tangents parallel to the guide's normal.
         • Tangent to guide - Causes the loft to touch the guide with tangents on the guide' s plane.
         • Match tangent - Causes the loft to match the face tangent of the guides adjacent to the profile.
         • Match curvature - Causes the curvature of the loft faces to match the curvature of the guides adjacent to the profile.

         Make sure that your sketch is consistent with what you are selecting, if the sketch is inconsistent with Match tangent and it is selected, the loft will fail. The same is true for Match curvature.

8. Trim guides becomes available when Guides and continuity is selected. This option allows you to control how the guides influence the loft operation, specifically to trim the loft operation to the boundaries of the guides.

   The image below is without any Trim selected, the loft extends the length of the profiles and also the length of the guides (which are highlighted below):

   

   下方的圖片選取了 [修剪導引]，會將疊層拉伸沿著導引修剪至輪廓與導引的相交處：

   

9. To create a centerline equivalent, select a Path for the loft to follow (and create intermediate sections along the path for the loft to reference).
   1. 按一下「路徑」旁的方塊。
   2. 選擇邊線、曲線與草圖來做為疊層拉伸的路徑 (中心線導引)。
   3. 指定沿路徑要使用的剖面數量 (居間剖面數)。使用的剖面數量越多，路徑會更精準地進行。

   For example: Straight line selected as the path, section count = 3

   

   選取樣條做為路徑，剖面數量 = 10

   

10. Optionally, select Connections to have more control on the twist of the resulting surface. If there are guides, those are used for alignment, if there are no guides then Onshape estimates the proximity within the existing vertices. It is best to have at least two vertices on each profile and use the matching vertices to control twist:
    1. 按一下「連接」。系統會以紫紅色顯示自動連接。只有在沒有「配對連接」項目時才會顯示自動連接。
    2. Select one set of vertices (one vertex on each region/face/edge/point) or a vertex and a curve:

       

    3. Use the manipulator to change the alignment of the vertices/edges:

       

11. Optionally, select Show isocurves to show a mesh overlay on the loft surface. The Count determines the number of isocurves.

    

12. 對於「加入」結果的操作，選擇性地核取「全部合併」，或是選擇一個「合併範圍」來選取要與新 (新增) 零件合併的零件。詳細資訊請參考下方的「合併範圍」。
13. 按一下 。

1. Click .

   

2. Select Thin Creation type.

Onshape 會記住選取的項目 (實體、曲面或薄件)，在後續的操作中打開對話方塊時即會有之前選取的項目。

3. 指定「結果」操作類型：

   • New - Create a new solid.
   • Add - Add to an existing solid.
   • Remove - Subtract from an existing solid.
   • Intersect - Keep only the intersection of two (or more) solids.

4. Select Profiles (a region, face, edge, or point) and then optional cross-sections (in order of the loft direction) and finally the end (region, face, edge, or point).

   Select more profiles to create a composite selection.

   

5. 執行下列操作之一：

   1. To use a symmetric thickness, check the Mid plane option and then enter the Thickness value. The loft will extend equally in both directions from the midplane.

      

   2. To specify individual wall thicknesses, uncheck the Mid plane option. Then, enter the Thickness 1 wall value and Thickness 2 wall value. Click the Flip wall arrow to flip Thickness 1 with Thickness 2.

      

6. To refine the shape further, expand, End conditions, then select a Profile condition to define the derivative constraints on the start and end profiles:
   1. Normal to profile - Causes the loft to touch the profile with tangents parallel to the profile's normal

      

   2. Tangent to profile - Causes the loft to touch the profile tangent to the profile plane.

      

   3. Match tangent - Causes the loft to match the tangents of model faces adjacent to the profile face (if available). Optionally, when selected, the Adjacent faces field is enabled. Pick any face in which underlying geometry is coincident with at least one profile part's curve (the face and edge do not need to intersect or be part of the same part).
   4. Match curvature - Causes the loft to match the curvature of model faces adjacent to the profile face (if available). Optionally, when selected, the Adjacent faces field is enabled. Pick any face in which underlying geometry is coincident with at least one profile part's curve. (The face and edge do not need to intersect or be part of the same part.)

7. Trim profiles - Trim the loft operation to the intersection of the profiles and the guides, along the profiles. The image below shows the profiles trimmed, and the Guides selected:

   

   下圖的圖片顯示同時選取了 [修剪導引] 與 [修剪輪廓]，會將疊層拉伸同時沿著導引與輪廓修剪：

   

8. Optionally, use a guide curve or curves for the loft to follow; guide curves must be touching the outsides of the profiles, not the centers.
   1. Check the Guides and continuity box.
   2. 選擇要用來做為導引的一或多條曲線。
   3. (Optional) To select tangentially connected curves as a single guide, click the down arrow next to the selected guide to open the field for more selections.
      1. Make additional selections:
         

         • 1 and 2: Each of these is a single guide selection (“Edge of Loft 1” and “Edge of Sketch 3”).

         • 3: Click the arrow next to the guide name to expand the field.

         • 4: The blue highlighting indicates that field is active. At this point, you can select more adjacent curves to create a composite guide selection.

      2. (Optional) For further definition, use the Continuity condition on the guide. Continuity can be:
         • Normal to guide - Causes the loft to touch the guide with tangents parallel to the guide's normal.
         • Tangent to guide - Causes the loft to touch the guide with tangents on the guide's plane.
         • Match tangent - Causes the loft to match the face tangent of the guides adjacent to the profile.
         • Match curvature - Causes the curvature of the loft faces to match the curvature of the guides adjacent to the profile.

         Make sure that your sketch is consistent with what you are selecting, if the sketch is inconsistent with Match tangent and it is selected, the loft will fail. The same is true for Match curvature.

9. Trim guides becomes available when Guides and continuity is selected. This option allows you to control how the guides influence the loft operation, specifically to trim the loft operation to the boundaries of the guides.

   The image below is without any Trim selected, the loft extends the length of the profiles and also the length of the guides (which are highlighted below):

   

   下方的圖片選取了 [修剪導引]，會將疊層拉伸沿著導引修剪至輪廓與導引的相交處：

   

10. To create a centerline equivalent, select a Path for the loft to follow (and create intermediate sections along the path for the loft to reference).
    1. Click the Path box.
    2. 選擇邊線、曲線與草圖來做為疊層拉伸的路徑 (中心線導引)。
    3. 指定沿路徑要使用的剖面數量 (居間剖面數)。使用的剖面數量越多，路徑會更精準地進行。

    For example: Straight line selected as the path, section count = 3

    

    選取樣條做為路徑，剖面數量 = 10

    

11. Optionally, select Connections to have more control on the twist of the resulting surface. If there are guides, those are used for alignment, if there are no guides then Onshape estimates the proximity within the existing vertices. It is best to have at least two vertices on each profile and use the matching vertices to control twist. The automatic connections are displayed in magenta. Automatic connections are only visible if there are no Match connection entries.
    1. Select one set of vertices (one vertex on each region/face/edge/point) or a vertex and a curve:

       

    2. Use the manipulator to change the alignment of the vertices/edges:

       

12. Optionally, select Show isocurves to show a mesh overlay on the loft surface. The Count determines the number of isocurves.

    

13. Check the Trim ends option to start and terminate the loft at the profiles.

    

    Uncheck it to create end faces tangent to the profiles.

    

14. For the Add result operation, optionally check Merge with all, or select a Merge scope to select parts with which to merge the new (additional) part.
15. 按一下 。

Surface / Add / Guides / Match curvature - Create material and add it to the existing material.

New - Create new material that results in a new part or surface.

Add - Create material and add to the existing material. (This example is merge with all existing material; you could also select one part as the merge scope.)

• 當加入材料時，您可以選擇將材料與其幾何接觸或相交的零件合併。

• 如果幾何僅與一個零件接觸或相交，則自動會將該零件加入至合併的範圍中。

  • 如果多個零件與幾何接觸或相交，則有模糊的情況產生，您必須選擇要合併的零件 (合併範圍)。
  • 一個選擇多個接觸或相交零件的捷徑是核取 [全部合併] 來將接觸或相交的零件加入至合併範圍中。
  • 請注意，如果布林運算是設定為「加入」、「移除」、或「相交」，且在合併範圍內沒有設定任何項目，則特徵會有錯誤。對於「新」的選項，因為不會對結果進行布林運算，所以不提供合併範圍。

選擇沿著疊層拉伸輪廓的草圖來從現有材料中移除材料；不適用於曲面中。

僅在所選幾何重疊處保留材料；如果需要，請選擇 [全部合併] 來完成操作；不適用於曲面中。

選擇一條路徑來做為疊層拉伸的同等中心線 (導引線)，並藉以控制疊層拉伸的整體形狀。這條導引線不一定要在中心。指定沿著路徑的居間剖面數量來微調延路徑所產生疊層拉伸的形狀。

未使用路徑的疊層拉伸：

使用路徑與 2 個居間剖面的疊層拉伸：

使用路徑與 20 個居間剖面的疊層拉伸：

可在零件與曲面上使用 [合併範圍]，讓您選擇要與新建立零件或曲面合併的特定零件或曲面。根據預設已選取了 [全部合併]。您可以取消核取該方塊來存取 [合併範圍] 的欄位，然後選擇要合併的零件或曲面。曲面必須與曲面合併，零件則須與零件合併。

合併範圍：全部合併

將擠出與其相交的所有零件合併

合併範圍：特定零件

選擇要合併的特定零件

選擇一組頂點 和/或邊線 (每個輪廓上一個)。

• 要獲得最佳的結果，所有的輪廓應該有相同的曲線線段數量。
• 頂點的選擇必須從每個輪廓中選擇一個頂點。
• 在疊層拉伸操作中使用的輪廓 (區域) 與導引在輸入欄位中必須是單一的輸入。
• 當操作多條邊線的導引曲線時，請確定一個草圖定義了導引；請從特徵清單中選擇該草圖。
• 請確定從疊層拉伸的開始到結束選擇了正確的輪廓 (區域、面、邊線或點) 順序。
• 導引曲線需要是平滑的 (多邊線曲線必須是相切的)，且必須接觸輪廓 (請使用重合或貫穿的限制條件)。
• 在建立疊層拉伸之後，於編輯的過程中使用 「成品」按鈕來顯示結果與微調操作。
• 目前不支援輪廓中的嵌套式迴圈。
• 要選擇多條相切連接的曲線做為單一導引，請從「特徵」清單中以完整草圖的方式選擇這些曲線，或在「零件」清單中以曲線的方式選擇。

1. 輕觸疊層拉伸工具。

   

   

2. Select Creation type:
   • Solid - Create parts or modify existing parts.
   • Surface - Create a surface along a sketch curve.
   • Thin - Create a a thin loft
3. Select a Result body operation type:
   • New - Create new material that results in a new part.
   • Add - Create new material and add to the existing material.
   • Remove - Take material away from a part.
   • Intersect - Leave material only where intersections exist.
4. Select Profiles to loft:

   First select the start profile (a region, face, edge, or point), and then optional cross-sections (in order of the loft direction) to help bound the loft, and finally the end (a region, face, edge, or point).

5. For Thin lofts, either check the Mid plane option and specify a wall thickness. The wall will extend equally from the mid plane. Alternately, uncheck the option and specify separate wall thicknesses. Toggle Flip wall to swap the thicknesses.

6. To refine the shape further, select a Profile condition to define the derivative constraints on the start and end profiles.

7. ToggleTrim profiles to trim the loft operation to the intersection of the profiles and the guides, along the profiles.
8. Toggle Guides and continuity to select a guide curve or curves for the loft to follow; guide curves must be touching the outsides of the profiles, not the centers.
9. Select a path (centerline guide) for the loft to follow (and create intermediate sections along the path for the loft to reference).
   1. Tap to toggle Path.
   2. 選擇邊線、曲線與草圖來做為疊層拉伸的路徑 (中心線導引)。
   3. 指定沿路徑要使用的剖面數量 (居間剖面數)。使用的剖面數量越多，路徑會更精準地進行。
10. Select optional vertices to match (to define corresponding locations on each profile):
    1. Tap to toggle Connections.
    2. 選擇一組頂點 (在每個區域/面/邊線/點上選擇一個頂點或邊線)。

11. Toggle the Trim ends option to start and terminate the loft at the profiles. Uncheck it to create end faces tangent to the profiles.

12. For the Add result operation, optionally toggle Merge with all, or select a Merge scope to select parts with which to merge the new (additional) part.

New - Create new material that results in a new part

Add - Create material and add to the existing material

當加入材料時，您可以選擇將材料與其幾何接觸或相交的零件合併：

• 如果幾何僅與一個零件接觸或相交，則自動會將該零件加入至合併的範圍中。
• 如果多個零件與幾何接觸或相交，則有模糊的情況產生，您必須選擇要合併的零件 (合併範圍)。

• A shortcut to selecting multiple touching or intersecting parts, you can check Merge with all to add all touching or intersecting parts to the merge scope.

  如果布林運算是設定為「加入」、「移除」、或「相交」，且在合併範圍內沒有設定任何項目，則特徵會有錯誤。對於「新」的選項，因為不會對結果進行布林運算，所以不提供合併範圍。

Remove - Take material away

Intersect - Leave material only where intersections exist

選擇一個路徑來做為疊層拉伸的中心線導引。指定沿著路徑的居間剖面數量來微調延路徑所產生疊層拉伸的形狀。

未使用路徑的疊層拉伸：

使用路徑與 1 個剖面的疊層拉伸：

使用路徑與 20 個居間剖面的疊層拉伸：

無

不選擇控制項類型的情況下執行疊層拉伸。

導引線

選擇導引線 (導引線必須接觸輪廓的外側而非中心)。

要選擇多條相切連接的曲線做為單一導引，請從特徵清單中以完整草圖的方式選擇這些曲線。

選擇起始輪廓形態與終止輪廓形態 (在起始與終止輪廓上有衍生的限制條件)。對於每個終止形態 (起始輪廓與終止輪廓)，您可以指定一個量值。

Normal to profile - Causes the loft to touch the profile with tangents parallel to the profile's normal

Tangent to profile - Causes the loft to touch the profile with tangents on the profile plane

Match tangent - Causes the loft to match the tangents of model faces adjacent to the profile face (if available).

選擇性使用，選取時系統會啟用「相鄰面」欄位。選取任何一個面，其基礎幾何須與至少一個輪廓零件的曲線重合 (面與邊線不需相交或是同一零件的一部分)。

Match curvature - Causes the loft to match the curvature of model faces adjacent to the profile face (if available).

選擇性使用，選取時系統會啟用「相鄰面」欄位。選取任何一個面，其基礎幾何須與至少一個輪廓零件的曲線重合 (面與邊線不需相交或是同一零件的一部分)。

選擇一組頂點 (在每個區域/面/邊線/點上選擇一個頂點)。

• 要獲得最佳的結果，所有的輪廓應該有相同的曲線線段數量。
• 頂點的選擇必須從每個輪廓中選擇一個頂點。
• 在疊層拉伸操作中使用的輪廓 (區域) 與導引在輸入欄位中必須是單一的輸入。
• 當操作多條邊線的導引曲線時，請確定一個草圖定義了導引；請從特徵清單中選擇該草圖。
• 請確定從疊層拉伸的開始到結束選擇了正確的輪廓 (區域、面、邊線或點) 順序。
• Guide curves need to be smooth (multi-edge curves must be tangent), and they must touch the profile (use Coincident or Pierce Constraints).
• 在建立疊層拉伸之後，在編輯的過程中使用「成品」按鈕來微調操作。
• 目前不支援輪廓中的嵌套式迴圈。

1. 輕觸疊層拉伸工具。

   

   

2. Select Creation type:
   • Solid - Create parts or modify existing parts.
   • Surface - Create a surface along a sketch curve.

3. Select a Result body operation type:
   • New - Create new material that results in a new part.
   • Add - Create new material and add to the existing material.
   • Remove - Take material away from a part.
   • Intersect - Leave material only where intersections exist.
4. Select Profiles to loft:

   First select the start profile (a region, face, edge, or point), and then optional cross-sections (in order of the loft direction) to help bound the loft, and finally the end (a region, face, edge, or point).

5. Select a path (centerline guide) for the loft to follow (and create intermediate sections along the path for the loft to reference).
   1. Tap to toggle Path.
   2. 選擇邊線、曲線與草圖來做為疊層拉伸的路徑 (中心線導引)。
   3. 指定沿路徑要使用的剖面數量 (居間剖面數)。使用的剖面數量越多，路徑會更精準地進行。
6. Select a control type (to help define the loft) or end conditions:
   • None
   • Guides - Select the guide lines (guide lines must be touching the outsides of the profiles, not the centers).

     To select a set of connected curves as a single chain, select them from the Feature list as a complete sketch.

   • End conditions - Select start profile condition and End profile condition (derivative constraints on the start and end profiles):
     • Normal to profile - Causes the loft to touch the profile with tangents parallel to the profile's normal
     • Tangent to profile - Causes the loft to touch the profile with tangents on the profile plane
     • Match tangent - Causes the loft to match the tangents of model faces adjacent to the profile face (if available). Optionally, when selected, the Adjacent faces field is enabled. Pick any face in which underlying geometry is coincident with at least one profile part's curve (the face and edge do not need to intersect or be part of the same part).
     • Match curvature - Causes the loft to match the curvature of model faces adjacent to the profile face (if available). Optionally, when selected, the Adjacent faces field is enabled. Pick any face in which underlying geometry is coincident with at least one profile part's curve (the face and edge do not need to intersect or be part of the same part).

     For each end condition (start profile and end profile), you are able to specify a magnitude (use the number pad to change these values).

7. Select optional vertices to match (to define corresponding locations on each profile):
   1. Tap to toggle Connections.
   2. 選擇一組頂點 (在每個區域/面/邊線/點上選擇一個頂點或邊線)。

New - Create new material that results in a new part

Add - Create material and add to the existing material

當加入材料時，您可以選擇將材料與其幾何接觸或相交的零件合併：

• 如果幾何僅與一個零件接觸或相交，則自動會將該零件加入至合併的範圍中。
• 如果多個零件與幾何接觸或相交，則有模糊的情況產生，您必須選擇要合併的零件 (合併範圍)。

• A shortcut to selecting multiple touching or intersecting parts, check Merge with all to add all touching or intersecting parts to the merge scope.

  如果布林運算是設定為「加入」、「移除」、或「相交」，且在合併範圍內沒有設定任何項目，則特徵會有錯誤。對於「新」的選項，因為不會對結果進行布林運算，所以不提供合併範圍。

Remove - Take material away

Intersect - Leave material only where intersections exist

選擇一個路徑來做為疊層拉伸的中心線導引。指定沿著路徑的居間剖面數量來微調延路徑所產生疊層拉伸的形狀。

未使用路徑的疊層拉伸：

使用路徑與 1 個剖面的疊層拉伸：

使用路徑與 20 個居間剖面的疊層拉伸：

無

不選擇控制項類型的情況下執行疊層拉伸。

導引線

選擇導引線 (導引線必須接觸輪廓的外側而非中心)。

要選擇多條相切連接的曲線做為單一導引，請從特徵清單中以完整草圖的方式選擇這些曲線。

選擇起始輪廓形態與終止輪廓形態 (在起始與終止輪廓上有衍生的限制條件)。對於每個終止形態 (起始輪廓與終止輪廓)，您可以指定一個量值。

Normal to profile - Causes the loft to touch the profile with tangents parallel to the profile's normal

Tangent to profile - Causes the loft to touch the profile with tangents on the profile plane

Match tangent - Causes the loft to match the tangents of model faces adjacent to the profile face (if available).

選擇性使用，選取時系統會啟用「相鄰面」欄位。選取任何一個面，其基礎幾何須與至少一個輪廓零件的曲線重合 (面與邊線不需相交或是同一零件的一部分)。

Match curvature - Causes the loft to match the curvature of model faces adjacent to the profile face (if available).

選擇性使用，選取時系統會啟用「相鄰面」欄位。選取任何一個面，其基礎幾何須與至少一個輪廓零件的曲線重合 (面與邊線不需相交或是同一零件的一部分)。

選擇一組頂點 (在每個區域/面/邊線/點上選擇一個頂點)。

• 要獲得最佳的結果，所有的輪廓應該有相同的曲線線段數量。
• 頂點的選擇必須從每個輪廓中選擇一個頂點。
• 在疊層拉伸操作中使用的輪廓 (區域) 與導引在輸入欄位中必須是單一的輸入。
• 當操作多條邊線的導引曲線時，請確定一個草圖定義了導引；請從特徵清單中選擇該草圖。
• 請確定從疊層拉伸的開始到結束選擇了正確的輪廓 (區域、面、邊線或點) 順序。
• Guide curves need to be smooth (multi-edge curves must be tangent), and they must touch the profile (use Coincident or Pierce Constraints).
• 在建立疊層拉伸之後，在編輯的過程中使用「成品」按鈕來微調操作。
• 目前不支援輪廓中的嵌套式迴圈。