Sheet Metal Flange

To create a flange:

1. While in a Part Studio, click .

   

2. Select the edges or side faces along which to create flanges.
3. Specify the details of the flange:
4. Flange alignment:
   • Inner - Align the inner wall of the flange wall with the inner edge of the side lip.
   • Outer - Align the outer wall of the flange wall with the outer edge of the side lip.
   • Middle - Align the mid-plane of the flange wall with a theoretical line halfway between the inner and outer edge of the lip.
   • Hold line - Align the bend of a flange at the selected edge or face.
    

Cross section showing Flange alignment, from left to right: Inner, Outer, Middle, Hold line.

5. End type - Select one of the following End types:
   • Blind - Specify a flange distance, measured from the intersection point of the outer edges of the base and the flange to the tip of the flange.
     • Distance - Specify a distance value.
   • Up to entity - Extend the flange up to a selected entity.
     • Up to entity - Select an entity; for example, an edge, face, or plane.
   • Up to entity with offset - Extend the flange up to a selected entity and specify the addition of an offset.
     • Up to entity - Select an entity; for example, an edge, face, or plane. 
     • Offset value - Enter an offset value from the selected Up to entity.
6. Select an angle control type to specify how to orient the angle of the flange bend:
   • Bend angle - Enter a specific angle value, measured from the edge from which to extend the flange.
   • Align to geometry - Align the flange parallel to the selected geometry.
     • Parallel to - Select an edge, face, or plane for the flange's parallel alignment.
   • Angle from direction - Align the flange directionally from the selected geometry.

     • Direction - Select an edge, face, or plane for the flange's directional alignment.

     • Angle - Enter the flange angle from 1 to 359 degrees from the selected Direction edge, face, or plane.

   1. Choose a direction using the Opposite side arrow (toggle the direction).
7. Check Partial flange to specify a flange offset along the flange edge:

   

   1. Select Overall parameters:

8. Automatic miter - Check to automatically trim or extend the intersecting flanges for a miter. Uncheck to specify a custom miter angle.
   • Miter angle - Enter a custom miter angle value.
9. Use model bend radius - Check to use the inside bend radius specified for the sheet metal model, or leave unchecked to enter a custom Bend radius.
   • Bend radius - Enter a custom bend radius value

10. Partial flange - Uncheck if the flange extends the full length of the Edges or side faces to flange. Check to specify a partial flange.

    1. Overall parameters - Specify if the flange is:

       • Per edge - Per individual edge.

       • Per chain - Per group of edges.

    2. Choose a direction using the Flip sides arrow (toggle the direction).

    3. Hold adjacent edges - Keep checked to extend the flange edge the full edge length, or deselect to limit the flange edge to the length of the partial flange.

    4. End Conditions - Set the partial flange end conditions:

       • Bound type - Select one of the following:

         • Blind - Specify a flange distance, measured from the intersection point of the outer edges of the base and the flange to the tip of the flange.
         • Up to entity - Extend the flange up to a selected entity (for example, an edge, face, or plane).
         • Up to entity with offset - Extend the flange up to a selected entity (for example, an edge, face, or plane) and specify the addition of an offset value.
           • Offset value - Enter an offset value from the selected Up to entity.

       • Second bound - Check to set a secondary bound to offset the flange's secondary direction, with the same set of options as the primary bound (for example, Bound type).

11. Click to accept the feature; the Flange in the Feature list.

To modify a flange, use a Direct Edit tool such as Move face.

When a sheet metal model is active (in the process of being created or edited), additional tools are available:

• Flange - Create a wall for each edge selected, connected to the selected edge with a bend.
• Hem - Create a hem for each edge/face selected, on an existing sheet metal part.
• Tab - Add a tab to a sheet metal flange.
• Bend - Bend a sheet metal model along a reference line, with additional bend control options.
• Make joint - Convert the intersection of two walls into a joint feature, either a bend (walls joined by cylindrical geometry) or a rip (small gap between two walls).
• Corner - Modify a corner type and relief scale.
• Bend relief - Modify a bend relief (the small cut made where the bend end meets the free edge), depth and relief width.
• Modify joint - Make changes to an existing joint, such as converting a bend to a rip. Currently available through the flat view table.
• Sheet metal table and flat view - Open and close the Rip/Bend tables and the visualization of the sheet metal model flat pattern. Use this table to convert rips to bends and vice versa.
• Finish sheet metal model - Closes (deactivates) the Sheet metal model; creates a feature in the Feature list.

To create a flange:

1. While in a Part Studio, tap .

2. Select the edges or side faces along which to create flanges.
3. Specify the details of the flange:
   1. Flange alignment:
      • Inner - Align the inner wall of the flange with the selected edge.
      • Outer - Align the outer wall of the flange with the selected edge.
      • Middle - Align the mid-plane of the flange wall with the selected edge.
      • Hold line - Align the bend of the flange with the selected edge.
   2. End type of the wall - Select Blind (specify a distance of the flange, measured from the intersection point of the outer edges of the base and the flange to the tip of the flange), Up to entity (select the entity or Mate connector -inferred or existing- to extend the flange to), Up to entity with offset (select the entity or Mate connector -inferred or existing- to extend towards and specify the offset value)
   3. Select an angle control type to specify how to orient the angle of the flange bend:
      • Bend angle - Enter a specific angle value, measured from the edge from which to extend the flange.
      • Align to geometry - Select an edge or Mate connector (inferred or existing)to align the flange parallel to.
      • Angle from direction - Select an edge or Mate connector (inferred or existing) from which to measure an angle for the flange.
   4. Choose a direction using the Flip arrow. (Toggle the direction with this arrow.)
   5. Automatic miter - Check to automatically trim or extend the intersecting flanges for a miter. Leave unchecked to specify a custom miter angle
   6. Use model bend radius - Check to use the inside bend radius specified for the sheet metal model, or leave unchecked to enter a custom value (Bend radius)
4. Select Partial flange to specify a flange offset along the flange edge:

   1. Chain type - Specify if the flange is per edge (individual edge) or per chain (per group of edges).

   2. Flip sides - Select to flip the flange side direction.

   3. Hold adjacent edges - Keep selected to extend the flange edge the full edge length, or deselect to limit the flange edge to the length of the partial flange.

   4. Bound type - Select Blind (specify a distance, or length, of the flange), Up to entity (select the entity or Mate connector -inferred or existing- to extend the flange to), or Up to entity with offset (select the entity or Mate connector -inferred or existing- to extend towards and specify the offset value).

   5. Second bound - Select to set a secondary bound to offset the flange's secondary direction, with the same set of options as the primary bound (for example, Bound type).

5. Tap to accept the feature; the Flange in the Feature list.

To modify a flange, use a Direct Edit tool such as Move face.

When a sheet metal model is active (in the process of being created or edited), additional tools are available:

• Flange - Create a wall for each edge selected, connected to the selected edge with a bend.
• Tab - Add a tab to a sheet metal flange.
• Make joint - Convert the intersection of two walls into a joint feature, either a bend (walls joined by cylindrical geometry) or a rip (small gap between two walls).
• Corner - Modify a corner type and relief scale.
• Bend relief - Modify a bend relief (the small cut made where the bend end meets the free edge), depth and relief width.
• Finish sheet metal model - Closes (deactivates) the Sheet metal model; creates a feature in the Feature list.